Fillet Weld dialog box

Creates a fillet weld feature in a weldment assembly. A welding symbol may be created simultaneously with the feature or it may be created in a separate operation.

The weld bead and the welding symbol are separate features in the welds folder of the browser. The welding symbol can be associated with the fillet bead feature so that changes to the fillet bead update the welding symbol values. Changes to the welding symbol cannot update the fillet bead feature. When consumed by a welding symbol, the fillet weld is a child node of the welding symbol.

Access:

Right-click the Welds folder in the browser and select Edit. On the ribbon, click Weld tab Weld panel Fillet.

The Bead box specifies the parameters for constructing the fillet weld.
Selection and Size	Selects the faces to define the fillet weld. Select the Chain check box to select tangent contiguous faces automatically.
	Leg Length constructs a fillet weld based on leg length (height and width). If only one value is entered, leg lengths are equal.
	Throat constructs a fillet weld based on the distance between the weld root and the face of the fillet weld.
	Direction changes the start position of an offset weld.
Contour	Specifies Flat, Convex, or Concave weld bead process shape and if appropriate, an offset distance. Offset is used with Concave or Convex contours to control the inward or outward bow of the weld bead face.
Intermittency	Specifies intermittency of a fillet weld bead, specific to the active standard. ANSI standard specifies bead length and the distance between bead centers. ISO, BSI, DIN, and GB standards specify bead length, spacing between beads, and the number of beads. JIS standard specifies bead length, the distance between bead centers and the number of beads.
Extents	Determines the method for starting and ending a fillet weld. A fillet weld can terminate on a work plane, on a planar face, or extend across all selected geometry for a full-length weld. The start and end position of a fillet weld can also be offset from a model edge. Click the arrow to select the extent method. All creates the weld bead across all selected geometry in the specified direction. From-To selects the beginning and ending faces or planes on which to terminate the weld feature. In a weldment, the faces or planes may be on other parts, but must be parallel. Start-Length creates a weld bead with a user specified offset distance and a fixed length. If the weld does not begin or end on an edge, use Start Offset to specify the set back distance.
Select Create Welding Symbol to expand the dialog box to set welding symbol parameters. Click this link to go to the Model Welding Symbol Reference.