Work axis reference

Access

Ribbon: 3D Model tab Work Features panel Axis

In a part, a work axis can be created in-line while using another work feature command. The Work Axis command terminates as soon as the work point is created.

Tip: To understand geometric dependencies, right-click a work feature in the browser or the graphics window, and then select Show Inputs. For example, you can right-click a work point to highlight the geometry from which it was created, such as a work axis and a work plane.

The Axis drop-down menu offers the following work axis creation options:

Axis: (legacy method)

Select:

Appropriate edges, lines, planes, or points to define a work axis.

Result:

Creates a work axis through the selected objects.

On Line or Edge

Select:

A linear edge. 2D and 3D sketch lines can also be selected.

Result:

The work axis created is collinear with the selected linear edge or sketch line.

Parallel to Line through Point

Select:

An endpoint, midpoint, sketch point, or work point. Then select a linear edge or sketch line.

Result:

The work axis created is parallel to the selected linear edge, through the point.

Through Two Points

Select:

Two endpoints, intersections, midpoints, sketch points, or work points. You cannot select midpoints in an assembly.

Result:

A work axis is created through the selected points, with its positive direction oriented in the direction from the first point to the second point.

Intersection of Two Planes

Select:

Two nonparallel work planes or planar faces.

Result:

A work axis is created coincident with the intersection of the planes.

Normal to Plane through Point

Select:

A planar face or work plane and a point.

Result:

The work axis created is perpendicular to the selected plane, through the point.

Through Center of Circular or Elliptical Edge

Select:

A circular or elliptical edge. Fillet edges can also be selected.

Result:

The work axis created is coincident with the circular, elliptical, or fillet axis.

Through Revolved Face or Feature

Select:

A revolved face or feature.

Result:

The work axis created is coincident with the face or feature axis.