Create sheet metal flange with offset width

Create a flange and define its width as an offset.

1. On the ribbon, click Sheet Metal tab Create panel Flange .
2. The Edge Select Mode is active. Select an edge. When creating a flange of an offset width, you select only a single edge.

   The flange previews along the edge selected using the default parameters.

3. Set a Distance for the height of the flange, or select To and select geometry to define the height.

   To change the side of the sheet metal face the flange is created on, click Flip Direction.

4. On the lower right of the dialog box, click More.
5. On the Extents Type drop-down list, click Offset.

   The start and end vertices of the edge are automatically selected.

6. To change the start reference, click Offset1 and select a work point, workplane, or face from which the flange is offset. Enter a value for the first offset distance.

   To change the end reference, click Offset2 and select a work point, workplane or face from which the flange is offset. Enter a value for the second offset distance.

7. On the upper area of the dialog box, specify an Angle for the flange (if other than the default of 90 degrees).
8. Use the default Bend Radius, or enter a value.
9. Specify the datum from which to measure the height (if not the intersection of the two outer faces).
10. If you do not want the outside face of the bend to align to the selected edge, specify the bend position relative to the selected edge.
11. If necessary, modify any Unfold, Bend, or Corner settings that differ from the options defined by Sheet Metal Style. The options are on the corresponding dialog box tabs.
12. Click OK.