To Work with Sketch Dimensions

You can add, edit, show, and delete dimensions; you can also specify how dimensions appear.

Add Dimensions

1. In a sketch, click Sketch tab Constrain panel Dimension (2D sketch) or 3D Sketch tab Constrain panel Dimension (3D sketch).
2. In the graphics window, click the geometry that you want to dimension and then click to place the dimension.

   In a 3D sketch, the dimension text is parallel to a plane created by the two selections.

3. Continue selecting geometry to create additional dimensions, or right-click and choose OK.

Edit Dimensions

1. In a sketch, double-click the dimension you want to edit, or click the Dimension command in the Constrain panel and then click the dimension you want to edit.
2. In the Edit Dimension dialog box, do any of the following:
   • Enter a new value in the dimension field.
   • Click the arrow, choose Measure, and then click the geometric element whose measurement you want to use.
   • Click the arrow, choose Show Dimensions, and then click the geometric element you want to measure.
   • Click the arrow and choose a value from the list.
   Note: You can also enter or edit an expression that defines a parameter. For example, enter HGHT = 5mm. The expression is parsed to create the parameter HGHT and assign it a value of 5 mm.
3. Click the check mark to accept the new dimension.

Show Me How to Edit Dimensions

Delete Dimensions

• Select the dimension in the graphics window and press Delete, or right-click and choose Delete.

Show/Hide Dimensions

Make dimensions visible so you can edit them.

• Right-click a feature in the browser or graphics window and choose Show Dimensions.
• Right-click a sketch in the browser and toggle on Dimension Visibility.
• Select View Tab, Visibility panel, Object Visibility, and select or deselect the Sketch Dimensions check box to show or hide all sketch dimensions.
• Double click the sketch node in the browser to edit the sketch. Sketch Dimensions are on by default when editing sketches. Select View Tab, Visibility panel, Object Visibility, and deselect the Sketch Dimensions check box to hide sketch dimensions.
  Note: When the Sketch Dimensions option is deselected, it overrides the individual sketch dimension visibility set in the context menu for the sketch.

Change How Dimensions Appear

• In an active sketch, choose one of the dimension display icons in the status bar:
  • Value: Displays sketch dimensions as the calculated value.
  • Name: Displays sketch dimensions as the parameter name.
  • Expression: Displays sketch dimensions as the specified parametric expression.
  • Tolerance: Displays sketch dimensions with a specified tolerance.
  • Precise Value: Displays sketch dimensions as a value, ignoring any precision.
  Note: You can also change how sketch dimensions appear by using the Dimension Properties dialog box. Right-click a dimension in the graphics window and choose Dimension Properties. In the Dimension Properties dialog box, click the Document Settings tab and choose an option from the Modeling Dimension Display menu.

Convert Driven Dimensions to Normal Dimensions

Only normal dimensions can be manually edited. Convert driven dimensions to normal dimensions so you can edit them.

In an over-constrained sketch, you may have to first convert other dimensions to driven (reference) parameters, or remove some dimensions or constraints, before you can convert driven dimensions to normal dimensions.

1. In a sketch, select the driven dimension or dimensions that you want to convert.
2. Click Sketch tab Format panel > Driven Dimension (2D sketches) or 3D Sketch tab Format panel Driven Dimension (3D sketches) to deselect it and make the dimension or dimensions normal.