Overlay drawing views use positional representations to show an assembly in multiple positions in a single view.
Overlay views are available for unbroken base, projected, and auxiliary views. Each overlay view can reference a design view representation independent of the parent view.
In the drawing browser, overlay views are shown as child nodes to the parent view, displayed as "PosRepName: ViewNumber: ModelName." You right-click an overlay view node to open the model file using the positional representation set by the overlay view.
Add dimensions between overlay views to show the distance a component has moved from its position in another representation. Drawing dimensions automatically update if the model position changes.
Guidelines for Working with Overlay Views
- In the assembly, create design view representations that show only components of interest. For an uncluttered overlay view, specify a design view representation when placing the overlay view.
- An overlay view can be associative to a defined design view representation.
- A positional representation can be used in multiple overlay views. In the assembly file, create as many positional representations as necessary to show different positions.
- To change to a different positional representation for an overlay view, delete the overlay view and specify a new positional representation when placing a new overlay view.
- If you delete a positional representation in the model, the drawing view reverts to the master positional representation.
- If you convert an assembly to a weldment, its positional representations and overlay views are deleted.
- Overlay views cannot be moved from their parent views or copied. The parent view can be moved or copied but overlay views are not included.
- The design view can be different from the parent view, and each overlay view can use a different design view representation.
Create Overlay Views
- On the ribbon, click Place Views tab
Create panel Base, and then in the Drawing View dialog, specify the assembly file and the design view. - On the ribbon, click Place Views tab Create panel Overlay, and then click the base view.
- In the Overlay View dialog, on the Positional Representation box, click the arrow and select a positional representation
- Edit the overlay view as desired.
- (Optional) Add additional overlay views to the base view to show various positions.
- (Optional) Create additional projected and auxiliary views and create overlay views for each.
Edit Overlay Views
You use the Edit Overlay dialog to edit overlay views. If you want to use a different positional representation for the overlay view, delete the overlay view and recreate the view, specifying the positional representation in the Drawing View dialog.
- Right-click an overlay view in the drawing browser and select Edit View.
- In the Overlay View dialog:
- On the Design View box, click the arrow and specify a design view representation. If desired, Associative to update the view when changes are made to the associative design view representation in the assembly environment.
- In the Label box:
- Clear the Use Positional Rep Name check box to enter a new name or accept the default.
- If appropriate, click Toggle Label Visibility to change the visibility of the view label.
- Click Edit View Label to edit the view label in the Format Text dialog.
- In the Display box, select:
- Tangent Edges to show tangent edges.
- Foreshortened to shorten the length of tangent edges to distinguish them from visible edges.
- Work Features to display them on the view.
- In the Style box, select:
- Hidden Lines, Remove Hidden Lines, or Shaded display style.
- Style from Base to show the overlay view in the same line style as the parent view.
- For Layer, click the arrow and select:
- As Overlay to set view items to the line style specified by the Layer style.
- As Part to show standard lines styles used in the part model. Components marked as Reference displays in the reference layer style.