Define a step with the proper time incrementation and nonlinear solution controls that best allow Helius PFA to reach a converged solution.
We have already defined our model geometry and are now ready to create a load step. Many linear elastic analyses require only a single increment per step. However, a single increment is inadequate for simulations of progressive failure. With the Nastran input file (.nas) still open in a text editor:
NLPARM = 1
NLPARM 1 100 ITER 1 1000 ALL+ + 1000 + +
Together, these 3 lines define the set of nonlinear parameters to use for the analysis. The NLPARM we defined uses 100 increments over a total time of 1.0. We have also requested that 1000 equilibrium iterations be performed before the code evaluates the need to reduce the time incrementation. This allows Autodesk Nastran to take advantage of the improved convergence characteristics provided by Helius PFA. We also used the NLSTEP entry to modify the default force convergence tolerance.
For additional details on the NLPARM entry as it pertains to Helius PFA, refer to the Nonlinear Solution Control Parameters.
SUBCASE 1 TITLE = Nonlinear Static Analysis ECHO = NONE DISPLACEMENT(PLOT) = ALL SPCFORCE(PLOT) = ALL NLSTRESS(PLOT) = ALL STRESS(PLOT,CORNER) = ALL ELSTRAIN(GAUSS) = ALL ELSTRESS(GAUSS) = ALL SPC = 2001 NLPARM = 1 $ BEGIN BULK $ PARAM,UNITS,IN-LBF-BTU-SEC PARAM,LGDISP,0 PARAM,OGEOM,NO PARAM,AUTOSPC,YES PARAM,GRDPNT,0 PARAM,NLTOL,2 PARAM,SOLUTIONERROR,OFF PARAM,HEXINODE,OFF PARAM,HEXREDORD,OFF NLPARM 1 100 ITER 1 1000 ALL+ + 1000 + + $