How to show and hide surfaces for best results in drawing views and to support annotations.
When you create a view of a part file that contains only surfaces, only the surfaces that are set to Visible appear in the drawing view. After view creation, any surfaces in the corresponding part file that are set to Invisible will no longer display in the drawing file.
After you create a drawing view, you can include or exclude surfaces from drawing views. Files that contain only surfaces automatically include the surfaces in a drawing view.
A drawing view can include open or closed surfaces, model surfaces, thickened surfaces, or derived surfaces. A drawing view cannot include construction surfaces. You must first use Copy Object to place construction surfaces to the part environment before including them in a drawing view.
Drawing Views of Models with a Mixture of Solids and Surfaces
When placing a base view of an assembly with a mixture of solid and surface or mesh parts, in the Open dialog box, on the Recovery tab, select the inclusion or exclusion option to meet your needs.
Surfaces in Child Views
After you create a base (parent) view in which you have included or excluded surfaces, newly created child views inherit the same visibility characteristics.
If a child view already exists, including or excluding surfaces on the parent view does not update the child view. You must include or exclude surfaces in each child view individually.
In section and breakout views, hatching does not show on regions defined by a surface. Hatching is visible only on a solid body.
Edges and Annotations for Surfaces
You can apply edge properties to surface edges and model edges.
After a surface is included in a view, you can apply annotations to surface view edges. Surfaces are not counted separately from the part for parts list quantities.
Create Views Containing both Solid Bodies and Surfaces
By default, when you create a view of a part that contains solid bodies and surfaces, the view contains solid bodies but no surfaces.
Inclusion or exclusion of surfaces in child views is the same as the base (parent) view. If you include or exclude surfaces in a parent view after child views are created, they are not reflected in the child views.
- On the ribbon, click
Place Views tab
Create panel
Base.
- In the Drawing View dialog, select a part (or assembly file in Inventor) that contains parts with a mixture of solids and surfaces.
- On the Component tab, specify the Representation, Scale, Label, and Style.
- On the Model tab, specify Reference Data, and weldment information when enabled.
- On the Display tab, specify the display options to use in the view.
- On the Recovery Options tab, specify whether or not to include surface and mesh bodies and work features.
Create Views Containing Surfaces but No Solid Bodies
When you create a view that contains surfaces but no solids, the view in the graphics window automatically includes surfaces. Surfaces are included in dependent views based on their inclusion or exclusion from the base (parent) view.
- On the ribbon, click
Place Views tab
Create panel
Base.
- In the Drawing View dialog, click the arrow on the File box, and select a part file that contains only surfaces.
- On the Component tab, specify Representation, Scale, Label, and Style.
- On the Model tab, specify Reference Data, and weldment information when enabled.
- On the Display Options tab, specify the display options to use in the view.
- On the Recovery Options tab, specify whether or not to include surface and mesh bodies and work features.
Edit existing Views to include or exclude surfaces
- In the browser, expand the file folder and right-click a surface. On the context menu, select Include All Surfaces or Visibility to add the surface to the view.
- To remove a surface from a view, right-click the surface in the browser and clear the Include All Surfaces or Visibility check mark.