Synopsis
Part Extrude Features live as children of the target IvAdoptedPart for the feature. Part Extrude Features are specified through three major categories: Derived Sketch, Extrude Extent, and Extrude Feature.
A sketch that represents the cross section of a feature. The factory part containing the sketch must be adopted into Intent. The sketch must be both visible and exported. For part extrusions, sketch placement creates a derived sketch part which is a child of the extrude feature child .
Determines the origin and termination of the extrude feature. Can be specified in one of four ways:
- Distance - The extrusion terminates at a specific distance.
- From/To Face - The extrusion originates at a specified face and terminates at a specified face.
- To Entity - The extrusion terminates at the specified entity.
- Through All - The extrusion continues indefinitely.
Specifies the extrude operation in one of three ways:
- Join - Adds the volume of a sketched feature to the existing feature.
- Cut - Removes the volume of a sketched feature from an existing feature.
- Intersect - Creates a feature from the shared volume of a sketched feature and an existing feature. Material not included in the shared volume is deleted.
Also specifies positive or negative taper angle for extrusion, normal to the sketch plane.
Mixins
IvFeature
IvPartExtrudeFeatureModifier
Parameters
| Name | Type | Description |
|---|---|---|
| operation | name | Optional. Extrude operation. :Join, :Cut, or :Intersect. Default value = :Cut. |
| taper | number | Optional. Extrude taper angle. Default value = 0. |
| face | string | Name of planar face or work plane on which the derived sketch is placed. |
| sketchName | string | Name of sketch. |
| sketchPart | part | Name of the part that contains sketchName. |
| origin | string | Name of vertex or work point , where sketch origin is placed. |
| xAxis | string | Name of edge or work axis, where sketch x-axis is placed. |
| reverseXdirection? | boolean | Optional. If true , the sketch's x-direction is reversed. Default value = False . |
| reverseSketchNormal? | boolean | Optional. If true , the sketch's normal is reversed. Default value = False . |
| extentDirection | name | (Applies to Through All and distance extent) Optional. Extrude direction. :Positive, :Negative, or :Symmetric. Default value = :Negative. |
| distance | number | (Applies to distance extent) Optional. Extrude distance. Default value = 1. |
| toFace | string | (Required for From/To Face extent) Name of the termination face. |
| extendToFace? | boolean | (Applies to From/To Face extent) Optional. If true , extend toFace to fully include the extrusion. Default value = False . |
| fromFace | string | (Required for From/To Face extent) Name of origination face. |
| extendFromFace? | boolean | (Applies to From/To Face extent) Optional. If true , extend fromFace to fully include the extrusion. Default value = True . |
| toEntity | string | (Required for To Entity extent) Name of termination entity. |
| throughAllType | name | (Required for Through All extent) A value of :ThroughAll specifies a extrusion that continues indefinitely. |
| NameFeatureGeometry? | boolean | Controls whether faces, edges, and vertices created by the feature will have names assigned to them for reference by other entities. |
Part Feature Entity Naming
There is an automatic entity naming mechanism for IvPartExtrudeFeature. The illustration shows the automatically-applied entity names as viewed in the Entity Naming Editor.
Example 1
This example creates a part which must be added as a child of an Assembly Document.
| Name : | PartExtrude_Part01 |
| Design : | Extrude_PartAdopt |
| Child Name : | Extrude_HalfCircle_1 |
| Child Design : | :Extrude_HalfCircle |
| Child Name : | extrudeFeature_1 | |
| Child Design : | :IvPartExtrudeFeature | |
| Name | Type | Supplied |
| distance | number | 8 |
| operation | name | :Cut |
| extentDirection | name | :Negative |
| sketchPart | part | Extrude_HalfCircle_1 |
| sketchName | string | "sketch_4" |
| face | string | "CS_plane" |
| origin | string | "CS_origin" |
| xAxis | string | "CS_xAxis" |
Example 2
This example creates a part which must be added as a child of an Assembly Document.
| Name : | PartExtrude_Part02 |
| Design : | Extrude_PartAdopt |
| Child Name : | Extrude_HalfCircle_1 |
| Child Design : | :Extrude_HalfCircle |
| Child Name : | extrudeFeature_1 | |
| Child Design : | :IvPartExtrudeFeature | |
| Name | Type | Supplied |
| distance | number | 8 |
| operation | name | :Join |
| extentDirection | name | :Positive |
| sketchPart | part | Extrude_HalfCircle_1 |
| sketchName | string | "sketch_4" |
| face | string | "CS_Plane" |
| origin | string | "CS_origin" |
| xAxis | string | "CS_xAxis" |
Example 3
This example creates a part which must be added as a child of an Assembly Document.
| Name : | PartExtrude_Part03 | |
| Design : | Extrude_PartAdopt | |
| Name | Type | Formula |
| TopPlaneOffset | number | 4.0 |
| Child Name : | Extrude_HalfCircle_1 | |
| Child Design : | :Extrude_HalfCircle | |
| Name | Type | Supplied |
| HexagonRad | number | 7.0 |
| Child Name : | IvPartExtrudeFeature_1 | |
| Child Design : | :IvPartExtrudeFeature | |
| Name | Type | Supplied |
| operation | name | :Join |
| sketchPart | part | Extrude_HalfCircle_1 |
| sketchName | string | "sketch_4" |
| extentDirection | name | :Positive |
| fromFace | string | "Bottom Plane" |
| toFace | string | "Top Plane" |
| origin | string | "CS_origin" |
| face | string | "CS_plane" |
| xAxis | string | "CS_xAxis" |