Edit Hole Note Reference

Modify formatting and note text for a hole note, overriding settings specified by the hole note style for the current document.

What's New: 2025

Access:

Right-click a hole note and select Edit Hole Note.

Note Format

Displays the format corresponding to the type of the selected hole.

Edit Field

Edits the content of the note. You can use a combination of text, inserted symbols, and variables to configure the annotation text of the note. For example:

C <DIST1> X <DIST2> would result in C 10 X 10

Tip: To stack text, type a correct stacking sequence, select it, right-click and choose Stack.

Values and Symbols

Adds values and symbols to the Edit Field. Click a value or symbol to add it to the hole note. To remove, place the cursor after the value or symbol in the Edit Window and backspace.

	Selects a symbol from the list to add it to the hole note.
Icon	Formula	Name	Origin / Column in Threads.xls
	<HDIA>	Hole Diameter Value	Size
	<HDPT>	Hole Depth Value	Model
	<CBDIA>	Counterbore/Spotface Value	Model
	<CBDPT>	Counterbore/Spotface Depth Value	Model
	<CSDIA>	Countersink Diameter Value	Model
	<CSANG>	Countersink Angle Value	Model
	<CSDPT>	Countersink Depth Value	Model
	<QTYNOTE>	Quantity Note adds text to indicate quantity. Not displayed if the hole note is used inside a hole table or if the quantity is less than two.	Format defined by
	<THRP>	Thread Designation Value	Thread Designation
	<THDCD>	Custom Designation Value	Custom Thread Designation
	<THDPT>	Thread Pitch Value	Pitch Dia
	<THRC>	Thread Class Value	Class
	<THRD>	Thread Depth Value	Model
	<TDDIA>	Tap Drill Diameter Value	Tap Drill
	<FST>	Fastener Type Value	Model (Clearance holes only)
	<FSZ>	Fastener Size Value	Model (Clearance holes only)
	<FIT>	Fastener Fit Value	Model (Clearance holes only)
	<DPOINT>	Drill Point Type Value	Model
	<TDIR>	Thread Direction Value	Model

Options

Use Default sets hole note to the default format.

Tap Drill selects the Tap Drill hole note type.

Right Handed Thread sets the hole note to indicate a right-handed thread.

Part Units sets the note to use the measurement units of the model. Check the box to use model units. Remove the check mark to use the measurement units specified by the dimension style.

Precision/Tolerance Settings opens the Precision and Tolerance dialog box so you can add tolerance information to values included in the note, or override the default precision settings.

Edit Quantity Note opens the Quantity Note dialog box. Allows custom configuration of the quantity note display in the context of a hole note (represented by the Quantity Note symbol).