Add dimensions in orthographic drawing views

1. On the ribbon, click Annotate tab Dimension panel Dimension .

2. In the graphics window, select the geometry and drag to display the dimension.

   • To add a linear dimension for a line or edge, click to select the geometry.

   • To add a linear dimension between two points, two curves, or a curve and a point, click to select each point or curve.

   • To add a linear symmetric or linear diametric dimension, select two parallel lines or edges, right-click, and then select Dimension TypeLinear Symmetric or Linear Diametric.

   • To add a linear foreshortened dimension, select two lines, edges, or points. Then right-click and select Dimension TypeLinear Foreshortened.

   • To add a radial or diametric dimension, click to select an arc or circle.

   • To add an angular dimension, select two lines.

   • To add a foreshortened angular or arc length dimension, select two lines, right-click, and then select Dimension TypeAngular Foreshortened, or Arc Length Foreshortened.

   • To add a dimension that rotates perpendicular to a selected edge: 1) Select a linear edge or 2 points. 2) Right-click and select Dimension Type Rotated. 3) Select a line to establish parallel or perpendicular direction of the dimension.

     

   • To annotate an arc segment with an arc length, angular, or chord length dimension, click to select the arc. Then right-click, and then select Dimension TypeArc Length, Arc Length Foreshortened, Angular, Angular Foreshortened, or Chord Length.

   • To add an implied intersection dimension, select the first curve, right-click, and then select the intersection. Select the second curve that defines the implied intersection, and then select the element (or other implied intersection) to dimension.

     Tip: Selected objects in the drawing determine the type of dimension and commands available in the context menu. To change the settings or use different options, right-click, and click a command on the menu.

3. Click to place the dimension in the appropriate location.

   Tip: When you create a leader line, hold the CTRL key on your keyboard to enable leader line snapping in 15° steps.

Show Me how to create aligned dimensions

Create aligned dimensions based on each of the following inputs:

• A single line
• Two points
• Context menu selection

Show Me how to create linear dimensions

Create linear dimensions based on the following inputs:

• A single line
• Two parallel lines
• Two points
• A line and an end point
• A line and a mid point

Create linear dimensions based on these inputs:

• A projected intersection and a line
• Two projected intersections

Create linear dimensions based on these inputs:

• Line and circle center point
• Line and circle quadrant point
• Line and circle nearest tangency
• Two circles between tangencies
• Two circles between center points

Show me how to create angle dimensions

Create angle dimensions based on each of the following inputs:

• Two edges to create an acute angle dimension
• Two edges to create an obtuse angle dimension
• Three points

Show Me how to create diameter dimensions

Create diameter dimensions using these context menu selections:

• Arrowheads Inside (On), Single Dimension Line (On), Leader from Center (Off) - Default
• Arrowheads Inside (On), Single Dimension Line (On), Leader from Center (On)
• Arrowhead Inside (On), Single Dimension Line (Off), Leader from Center (Off)
• Arrowhead Inside (Off), Single Dimension Line (Off), Leader from Center (Off)

Show me how to create radius dimensions

Create radius dimensions using these context menu selections:

• Arrowheads inside (Off), Leader from center (Off), Jogged (Off) - default
• Arrowheads inside (On), Leader from center (Off), Jogged (Off)
• Arrowheads inside (On), Leader from center (On), Jogged (On)