#include <Core/CoreAll.h>
#include <Fusion/FusionAll.h>
#include <sstream>
#include <iomanip>
using namespace adsk::core;
using namespace adsk::fusion;
Ptr<UserInterface> ui;
extern "C" XI_EXPORT bool run(const char* context)
{
Ptr<Application> app = Application::get();
if (!app)
return false;
ui = app->userInterface();
// Create a new document.
Ptr<Documents> documents = app->documents();
if (!documents)
return false;
Ptr<Document> doc = documents->add(DocumentTypes::FusionDesignDocumentType);
if (!doc)
return false;
Ptr<Product> product = app->activeProduct();
if (!product)
return false;
Ptr<Design> design = product;
if (!design)
return false;
// Set the design type to DirectDesignType (for non-parametric modelling)
design->designType(adsk::fusion::DesignTypes::DirectDesignType);
// Get the root component of the active design
Ptr<Component> rootComp = design->rootComponent();
if (!rootComp)
return false;
// Create the first component - containing a box
Ptr<Occurrences> occurrences = rootComp->occurrences();
if (!occurrences)
return false;
Ptr<Matrix3D> matrix = adsk::core::Matrix3D::create();
if (!matrix)
return false;
Ptr<Occurrence> firstComponentOccurrence = occurrences->addNewComponent(matrix);
if (!firstComponentOccurrence)
return false;
// Create sketch
Ptr<Sketches> sketches = firstComponentOccurrence->component()->sketches();
if (!sketches)
return false;
Ptr<Sketch> sketch = sketches->add(rootComp->xZConstructionPlane());
if (!sketch)
return false;
// Create a rectangle
Ptr<SketchLines> sketchLines = sketch->sketchCurves()->sketchLines();
if (!sketchLines)
return false;
Ptr<Point3D> startPoint = adsk::core::Point3D::create(0, 0, 0);
if (!startPoint)
return false;
Ptr<Point3D> endPoint = adsk::core::Point3D::create(5, 5, 0);
if (!endPoint)
return false;
sketchLines->addTwoPointRectangle(startPoint, endPoint);
// Get the profile defined by the rectangle
Ptr<Profiles> profiles = sketch->profiles();
if (!profiles)
return false;
Ptr<Profile> prof = profiles->item(0);
if (!prof)
return false;
// Create an extrusion input for the profile.
Ptr<Features> features = firstComponentOccurrence->component()->features();
if (!features)
return false;
Ptr<ExtrudeFeatures> extrudes = features->extrudeFeatures();
if (!extrudes)
return false;
Ptr<ExtrudeFeatureInput> extInput =
extrudes->createInput(prof, adsk::fusion::FeatureOperations::NewBodyFeatureOperation);
if (!extInput)
return false;
// Define that the extent of the extrusion is a distance extent of 5 cm.
Ptr<ValueInput> distance = adsk::core::ValueInput::createByReal(5);
if (!distance)
return false;
extInput->setDistanceExtent(false, distance);
// Create the extrusion.
Ptr<ExtrudeFeature> ext = extrudes->add(extInput);
if (!ext)
return false;
// Create the second component - containing a box that overlaps the box in the first component
Ptr<Occurrence> secondComponentOccurrence = occurrences->addNewComponent(matrix);
if (!secondComponentOccurrence)
return false;
// Create sketch
sketches = secondComponentOccurrence->component()->sketches();
sketch = sketches->add(rootComp->xZConstructionPlane());
// Create a rectangle
sketchLines = sketch->sketchCurves()->sketchLines();
startPoint = adsk::core::Point3D::create(3, 3, 0);
endPoint = adsk::core::Point3D::create(8, 8, 0);
sketchLines->addTwoPointRectangle(startPoint, endPoint);
// Get the profile defined by the rectangle
prof = sketch->profiles()->item(0);
// Create an extrusion input for the profile.
features = secondComponentOccurrence->component()->features();
extrudes = features->extrudeFeatures();
extInput = extrudes->createInput(prof, adsk::fusion::FeatureOperations::NewBodyFeatureOperation);
// Define that the extent of the extrusion is a distance extent of 5 cm.
distance = adsk::core::ValueInput::createByReal(5);
extInput->setDistanceExtent(false, distance);
// Create the extrusion.
ext = extrudes->add(extInput);
// Create the third component - containing a cylinder that overlaps the box in the second component
Ptr<Occurrence> thirdComponentOccurrence = occurrences->addNewComponent(matrix);
if (!thirdComponentOccurrence)
return false;
// Create sketch
sketches = thirdComponentOccurrence->component()->sketches();
sketch = sketches->add(rootComp->xZConstructionPlane());
// Create a circle
Ptr<SketchCircles> sketchCircles = sketch->sketchCurves()->sketchCircles();
if (!sketchCircles)
return false;
Ptr<Point3D> centerPoint = adsk::core::Point3D::create(8, 8, 0);
if (!centerPoint)
return false;
sketchCircles->addByCenterRadius(centerPoint, 2);
// Get the profile defined by the circle
prof = sketch->profiles()->item(0);
// Create an extrusion input for the profile.
features = thirdComponentOccurrence->component()->features();
extrudes = features->extrudeFeatures();
extInput = extrudes->createInput(prof, adsk::fusion::FeatureOperations::NewBodyFeatureOperation);
// Define that the extent of the extrusion is a distance extent of 5 cm.
distance = adsk::core::ValueInput::createByReal(5);
extInput->setDistanceExtent(false, distance);
// Create the extrusion.
ext = extrudes->add(extInput);
// Create a collection of the components to check for interference
Ptr<ObjectCollection> inputOccurrences = adsk::core::ObjectCollection::create();
if (!inputOccurrences)
return false;
inputOccurrences->add(firstComponentOccurrence);
inputOccurrences->add(secondComponentOccurrence);
inputOccurrences->add(thirdComponentOccurrence);
// Create the interferenceInput object and run the analysis.
Ptr<InterferenceInput> interferenceInput = design->createInterferenceInput(inputOccurrences);
if (!interferenceInput)
return false;
interferenceInput->areCoincidentFacesIncluded(false);
Ptr<InterferenceResults> results = design->analyzeInterference(interferenceInput);
if (!results)
return false;
// Create bodies for every intersection. This is not supported in Parametric designs.
Ptr<ObjectCollection> interferenceBodies = results->createBodies(true);
if (!interferenceBodies)
return false;
Ptr<Occurrence> resultsOccurrence = occurrences->item(occurrences->count() - 1);
if (!resultsOccurrence)
return false;
resultsOccurrence->activate();
// Fit the view
Ptr<Viewport> viewport = app->activeViewport();
if (!viewport)
return false;
viewport->fit();
// Report the results
int bodCount = 0;
for (Ptr<InterferenceResult> result : results)
{
Ptr<BRepBody> entOneBody = result->entityOne();
if (!entOneBody)
return false;
std::string comp1Name = entOneBody->parentComponent()->name();
Ptr<BRepBody> entTwoBody = result->entityTwo();
if (!entTwoBody)
return false;
std::string comp2Name = entTwoBody->parentComponent()->name();
double bodyVolume = result->interferenceBody()->volume();
std::stringstream bodyVolumeString;
bodyVolumeString << std::setprecision(2) << std::fixed << bodyVolume;
Ptr<BRepBody> interferenceBody = interferenceBodies->item(bodCount);
if (!interferenceBody)
return false;
bodCount++;
interferenceBody->name("Interference between " + comp1Name + " & " + comp2Name);
ui->messageBox(
"There is interference between " + comp1Name + " and " + comp2Name + " with a volume of " +
bodyVolumeString.str() + " cubic centimeters");
}
return true;
}
#ifdef XI_WIN
#include <windows.h>
BOOL APIENTRY DllMain(HMODULE hmodule, DWORD reason, LPVOID reserved)
{
switch (reason)
{
case DLL_PROCESS_ATTACH:
case DLL_THREAD_ATTACH:
case DLL_THREAD_DETACH:
case DLL_PROCESS_DETACH:
break;
}
return TRUE;
}
#endif // XI_WIN
import adsk.core, adsk.fusion, traceback
def run(context):
ui = None
try:
app = adsk.core.Application.get()
ui = app.userInterface
# Create a new document.
doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType)
product = app.activeProduct
design = adsk.fusion.Design.cast(product)
# Set the design type to DirectDesignType (for non-parametric modelling)
design.designType = adsk.fusion.DesignTypes.DirectDesignType
# Get the root component of the active design
rootComp = design.rootComponent
# Create the first component - containing a box
occurrences = rootComp.occurrences
matrix = adsk.core.Matrix3D.create()
firstComponentOccurrence = occurrences.addNewComponent(matrix)
# Create sketch
sketches = firstComponentOccurrence.component.sketches
sketch = sketches.add(rootComp.xZConstructionPlane)
# Create a rectangle
sketchLines = sketch.sketchCurves.sketchLines
startPoint = adsk.core.Point3D.create(0, 0, 0)
endPoint = adsk.core.Point3D.create(5, 5, 0)
sketchLines.addTwoPointRectangle(startPoint, endPoint)
# Get the profile defined by the rectangle
prof = sketch.profiles.item(0)
# Create an extrusion input for the profile.
features = firstComponentOccurrence.component.features
extrudes = features.extrudeFeatures
extInput = extrudes.createInput(prof, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)
# Define that the extent of the extrusion is a distance extent of 5 cm.
distance = adsk.core.ValueInput.createByReal(5)
extInput.setDistanceExtent(False, distance)
# Create the extrusion.
ext = extrudes.add(extInput)
# Create the second component - containing a box that overlaps the box in the first component
secondComponentOccurrence = occurrences.addNewComponent(matrix)
# Create sketch
sketches = secondComponentOccurrence.component.sketches
sketch = sketches.add(rootComp.xZConstructionPlane)
# Create a rectangle
sketchLines = sketch.sketchCurves.sketchLines
startPoint = adsk.core.Point3D.create(3, 3, 0)
endPoint = adsk.core.Point3D.create(8, 8, 0)
sketchLines.addTwoPointRectangle(startPoint, endPoint)
# Get the profile defined by the rectangle
prof = sketch.profiles.item(0)
# Create an extrusion input for the profile.
features = secondComponentOccurrence.component.features
extrudes = features.extrudeFeatures
extInput = extrudes.createInput(prof, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)
# Define that the extent of the extrusion is a distance extent of 5 cm.
distance = adsk.core.ValueInput.createByReal(5)
extInput.setDistanceExtent(False, distance)
# Create the extrusion.
ext = extrudes.add(extInput)
# Create the third component - containing a cylinder that overlaps the box in the second component
thirdComponentOccurrence = occurrences.addNewComponent(matrix)
# Create sketch
sketches = thirdComponentOccurrence.component.sketches
sketch = sketches.add(rootComp.xZConstructionPlane)
# Create a circle
sketchCircles = sketch.sketchCurves.sketchCircles
centerPoint = adsk.core.Point3D.create(8, 8, 0)
sketchCircles.addByCenterRadius(centerPoint, 2)
# Get the profile defined by the circle
prof = sketch.profiles.item(0)
# Create an extrusion input for the profile.
features = thirdComponentOccurrence.component.features
extrudes = features.extrudeFeatures
extInput = extrudes.createInput(prof, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)
# Define that the extent of the extrusion is a distance extent of 5 cm.
distance = adsk.core.ValueInput.createByReal(5)
extInput.setDistanceExtent(False, distance)
# Create the extrusion.
ext = extrudes.add(extInput)
# Create a collection of the components to check for interference
inputOccurrences = adsk.core.ObjectCollection.create()
inputOccurrences.add(firstComponentOccurrence)
inputOccurrences.add(secondComponentOccurrence)
inputOccurrences.add(thirdComponentOccurrence)
# Create the interferenceInput object and run the analysis.
interferenceInput = design.createInterferenceInput(inputOccurrences)
interferenceInput.areCoincidentFacesIncluded = False
results = design.analyzeInterference(interferenceInput)
# Create bodies for every intersection. This is not supported in Parametric designs.
interferenceBodies = results.createBodies(True)
# Activate the Intersections component created by Fusion that stores the interference bodies
resultsOccurrence = occurrences.item(occurrences.count-1)
resultsOccurrence.activate()
# Fit the view
viewport = app.activeViewport
viewport.fit()
# Report the results
bod = 0
for res in results:
comp1Name = res.entityOne.parentComponent.name
comp2Name = res.entityTwo.parentComponent.name
bodyVolume = str(round(res.interferenceBody.volume, 2))
interferenceBodies.item(bod).name = 'Interference between ' + comp1Name + ' & ' + comp2Name
ui.messageBox('There is interference between ' + comp1Name + ' and ' + comp2Name + ' with a volume of ' + bodyVolume + ' cubic centimeters')
bod += 1
except:
if ui:
ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))