As-Built Joint Sample

Python
C++

import adsk.core, adsk.fusion, traceback

def run(context):
    ui = None
    try:
        app = adsk.core.Application.get()
        ui = app.userInterface

        # Create a document.
        doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType)

        product = app.activeProduct
        design = adsk.fusion.Design.cast(product)

        # Get the root component of the active design
        rootComp = design.rootComponent

        # Create two new components under root component
        allOccs = rootComp.occurrences
        transform = adsk.core.Matrix3D.create()
        subOcc0 = allOccs.addNewComponent(transform)

        # Create sketch 1 in sub component 1
        subComp0 = subOcc0.component
        sketches0 = subComp0.sketches
        sketch0 = sketches0.add(subComp0.xZConstructionPlane)
        sketchCircles0 = sketch0.sketchCurves.sketchCircles
        centerPoint = adsk.core.Point3D.create(0, 0, 0)
        sketchCircles0.addByCenterRadius(centerPoint, 2.5)

        # Get the profile defined by the circle
        prof0 = sketch0.profiles.item(0)

        # Create an extrude input and make sure it's in the new component
        extrudes0 = subComp0.features.extrudeFeatures
        extInput0 = extrudes0.createInput(prof0, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)

        # Set the extrude input
        distance0 = adsk.core.ValueInput.createByString("5 mm")
        extInput0.setDistanceExtent(False, distance0)
        extInput0.isSolid = True

        # Create the extrude
        extrude0 = extrudes0.add(extInput0)

        # Get the end face of the created extrude
        endFaceOfExtrude0 = extrude0.endFaces.item(0)

        # Create a construction plane for extrude 2
        constructionPlanes_ = subComp0.constructionPlanes
        constructionPlaneInput = constructionPlanes_.createInput()
        constructionPlaneInput.setByOffset(endFaceOfExtrude0, adsk.core.ValueInput.createByString("20 mm"))
        constructionPlane = constructionPlanes_.add(constructionPlaneInput)
        constructionPlaneProxy = constructionPlane.createForAssemblyContext(subOcc0)

        # Create sketch 2 in sub component 2
        subOcc1 = allOccs.addNewComponent(transform)
        subComp1 = subOcc1.component
        sketches1 = subComp1.sketches
        sketch1 = sketches1.add(constructionPlaneProxy)
        sketchCircles1 = sketch1.sketchCurves.sketchCircles
        sketchCircles1.addByCenterRadius(centerPoint, 0.5)

        # Get the profile defined by the circle
        prof1 = sketch1.profiles.item(0)

        # Create an extrude input and make sure it's in the new component
        extrudes1 = subComp1.features.extrudeFeatures
        extInput1 = extrudes1.createInput(prof1, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)

        # Set the extrude input
        distance1 = adsk.core.ValueInput.createByString("50 mm")
        extInput1.setDistanceExtent(False, distance1)
        extInput1.isSolid = False

        # Create the extrude
        extrudes1.add(extInput1)

        # Create the AsBuiltJointInput
        asBuiltJoints_ = rootComp.asBuiltJoints
        asBuiltJointInput = asBuiltJoints_.createInput(subOcc0, subOcc1, None)

        # Create the AsBuiltJoint
        asBuiltJoints_.add(asBuiltJointInput)

    except:
        if ui:
            ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))

#include <Core/Application/Application.h>
#include <Core/Application/Documents.h>
#include <Core/Application/Document.h>
#include <Core/Application/Product.h>
#include <Core/Application/ValueInput.h>
#include <Core/Application/Viewport.h>
#include <Core/Application/Camera.h>
#include <Core/Geometry/Point3D.h>
#include <Core/Geometry/Matrix3D.h>
#include <Core/UserInterface/UserInterface.h>
#include <Fusion/Fusion/Design.h>
#include <Fusion/BRep/BRepFace.h>
#include <Fusion/BRep/BRepFaces.h>
#include <Fusion/Construction/ConstructionPlanes.h>
#include <Fusion/Construction/ConstructionPlaneInput.h>
#include <Fusion/Construction/ConstructionPlane.h>
#include <Fusion/Components/Component.h>
#include <Fusion/Components/AsBuiltJoints.h>
#include <Fusion/Components/AsBuiltJointInput.h>
#include <Fusion/Components/AsBuiltJoint.h>
#include <Fusion/Components/Occurrence.h>
#include <Fusion/Components/Occurrences.h>
#include <Fusion/Features/Features.h>
#include <Fusion/Features/ExtrudeFeature.h>
#include <Fusion/Features/ExtrudeFeatures.h>
#include <Fusion/Features/ExtrudeFeatureInput.h>
#include <Fusion/Sketch/Profile.h>
#include <Fusion/Sketch/Profiles.h>
#include <Fusion/Sketch/Sketch.h>
#include <Fusion/Sketch/Sketches.h>
#include <Fusion/Sketch/SketchCircle.h>
#include <Fusion/Sketch/SketchCircles.h>
#include <Fusion/Sketch/SketchCurves.h>
#include <Fusion/Sketch/SketchPoint.h>
#include <Fusion/Sketch/SketchPoints.h>

using namespace adsk::core;
using namespace adsk::fusion;

Ptr<UserInterface> ui;

extern "C" XI_EXPORT bool run(const char* context)
{
    Ptr<Application> app = Application::get();
    if (!app)
        return false;

    ui = app->userInterface();
    if (!ui)
        return false;

    Ptr<Documents> documents = app->documents();
    if (!documents)
        return false;

    Ptr<Document> doc = documents->add(DocumentTypes::FusionDesignDocumentType);
    if (!doc)
        return false;

    Ptr<Product> product = app->activeProduct();
    if (!product)
        return false;

    Ptr<Design> design = product;
    if (!design)
        return false;

    // Get the root component of the active design
    Ptr<Component> rootComp = design->rootComponent();
    if (!rootComp)
        return false;

    // Create sub component 1 under root component
    Ptr<Occurrences> occs = rootComp->occurrences();
    if (!occs)
        return false;
    Ptr<Matrix3D> transform = adsk::core::Matrix3D::create();
    if (!transform)
        return false;
    Ptr<Occurrence> subOcc0 = occs->addNewComponent(transform);
    if (!subOcc0)
        return false;

    // Create sketch 1 in sub component 1
    Ptr<Component> subComp0 = subOcc0->component();
    if (!subComp0)
        return false;
    Ptr<Sketches> sketches0 = subComp0->sketches();
    if (!sketches0)
        return false;
    Ptr<ConstructionPlane> xzPlane = rootComp->xZConstructionPlane();
    if (!xzPlane)
        return false;
    Ptr<Sketch> sketch0 = sketches0->add(xzPlane);
    if (!sketch0)
        return false;
    Ptr<SketchCurves> sketchCurves0 = sketch0->sketchCurves();
    if (!sketchCurves0)
        return false;
    Ptr<SketchCircles> sketchCircles0 = sketchCurves0->sketchCircles();
    if (!sketchCircles0)
        return false;
    Ptr<Point3D> centerPoint = Point3D::create(0, 0, 0);
    if (!centerPoint)
        return false;
    Ptr<SketchCircle> sketchCircle0 = sketchCircles0->addByCenterRadius(centerPoint, 2.5);
    if (!sketchCircle0)
        return false;

    // Get the profile defined by the circle
    Ptr<Profiles> profs0 = sketch0->profiles();
    if (!profs0)
        return false;
    Ptr<Profile> profile0 = profs0->item(0);
    if (!profile0)
        return false;

    // Create an extrude input
    Ptr<Features> feats0 = subComp0->features();
    if (!feats0)
        return false;
    Ptr<ExtrudeFeatures> extrudes0 = feats0->extrudeFeatures();
    if (!extrudes0)
        return false;
    Ptr<ExtrudeFeatureInput> extInput0 = extrudes0->createInput(profile0, FeatureOperations::NewBodyFeatureOperation);
    if (!extInput0)
        return false;

    // Set the extrude input
    Ptr<ValueInput> distance0 = ValueInput::createByString("5 mm");
    if (!distance0)
        return false;
    extInput0->setDistanceExtent(false, distance0);
    extInput0->isSolid(true);

    // Create the extrude
    Ptr<ExtrudeFeature> ext = extrudes0->add(extInput0);
    if (!ext)
        return false;

    // Get the end face of the created extrude
    Ptr<BRepFaces> endFaces = ext->endFaces();
    if (!endFaces)
        return false;
    Ptr<BRepFace> endFace = endFaces->item(0);
    if (!endFace)
        return false;

    // Create a construction plane for extrude 2
    Ptr<ConstructionPlanes> ctorPlanes = subComp0->constructionPlanes();
    if (!ctorPlanes)
        return false;
    Ptr<ConstructionPlaneInput> ctorPlaneInput = ctorPlanes->createInput();
    if (!ctorPlaneInput)
        return false;
    ctorPlaneInput->setByOffset(endFace, adsk::core::ValueInput::createByString("20 mm"));
    Ptr<ConstructionPlane> ctorPlane = ctorPlanes->add(ctorPlaneInput);
    if (!ctorPlane)
        return false;
    Ptr<ConstructionPlane> ctorPlaneProxy = ctorPlane->createForAssemblyContext(subOcc0);
    if (!ctorPlaneProxy)
        return false;

    // Create sub component 2 under root component
    Ptr<Occurrence> subOcc1 = occs->addNewComponent(transform);
    if (!subOcc1)
        return false;

    // Create sketch 2 in sub component 2
    Ptr<Component> subComp1 = subOcc1->component();
    if (!subComp1)
        return false;
    Ptr<Sketches> sketches1 = subComp1->sketches();
    if (!sketches1)
        return false;
    Ptr<Sketch> sketch1 = sketches1->add(ctorPlaneProxy);
    if (!sketch1)
        return false;
    Ptr<SketchCurves> sketchCurves1 = sketch1->sketchCurves();
    if (!sketchCurves1)
        return false;
    Ptr<SketchCircles> sketchCircles1 = sketchCurves1->sketchCircles();
    if (!sketchCircles1)
        return false;
    Ptr<SketchCircle> sketchCircle1 = sketchCircles1->addByCenterRadius(centerPoint, 0.5);
    if (!sketchCircle1)
        return false;

    // Get the profile defined by the circle
    Ptr<Profiles> profs1 = sketch1->profiles();
    if (!profs1)
        return false;
    Ptr<Profile> profile1 = profs1->item(0);
    if (!profile1)
        return false;

    // Create an extrude input
    Ptr<Features> feats1 = subComp1->features();
    if (!feats1)
        return false;
    Ptr<ExtrudeFeatures> extrudes1 = feats1->extrudeFeatures();
    if (!extrudes1)
        return false;
    Ptr<ExtrudeFeatureInput> extInput1 = extrudes1->createInput(profile1, FeatureOperations::NewBodyFeatureOperation);
    if (!extInput1)
        return false;

    // Set the extrude input
    Ptr<ValueInput> distance1 = ValueInput::createByString("50 mm");
    if (!distance1)
        return false;
    extInput1->setDistanceExtent(false, distance1);
    extInput1->isSolid(false);

    // Create the extrude
    Ptr<ExtrudeFeature> extrude1 = extrudes1->add(extInput1);
    if (!extrude1)
        return false;

    // Create the AsBuiltJoint
    Ptr<AsBuiltJoints> asBuiltJoints_ = rootComp->asBuiltJoints();
    if (!asBuiltJoints_)
        return false;
    Ptr<AsBuiltJointInput> asBuiltJointInput = asBuiltJoints_->createInput(subOcc0, subOcc1, nullptr);
    if (!asBuiltJointInput)
        return false;
    Ptr<AsBuiltJoint> asBuiltJoint = asBuiltJoints_->add(asBuiltJointInput);
    if (!asBuiltJoint)
        return false;

    // Fit to window
    Ptr<Viewport> viewPort = app->activeViewport();
    if (!viewPort)
        return false;
    Ptr<Camera> cam = viewPort->camera();
    if (!cam)
        return false;
    cam->isFitView(true);
    viewPort->camera(cam);


    return true;
}

#ifdef XI_WIN

#include <windows.h>

BOOL APIENTRY DllMain(HMODULE hmodule, DWORD reason, LPVOID reserved)
{
    switch (reason)
    {
    case DLL_PROCESS_ATTACH:
    case DLL_THREAD_ATTACH:
    case DLL_THREAD_DETACH:
    case DLL_PROCESS_DETACH:
        break;
    }
    return TRUE;
}

#endif // XI_WIN

As-Built Joint Sample

Description

Code Samples