import adsk.core, adsk.fusion, traceback
def run(context):
ui = None
try:
app = adsk.core.Application.get()
ui = app.userInterface
# Create a document.
doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType)
product = app.activeProduct
design = adsk.fusion.Design.cast(product)
# Get the root component of the active design
rootComp = design.rootComponent
# Create sketch
sketches = rootComp.sketches
sketch = sketches.add(rootComp.xZConstructionPlane)
sketchCircles = sketch.sketchCurves.sketchCircles
centerPoint = adsk.core.Point3D.create(0, 0, 0)
sketchCircles.addByCenterRadius(centerPoint, 5.0)
sketchLines = sketch.sketchCurves.sketchLines
sketchLines.addTwoPointRectangle(adsk.core.Point3D.create(6, 6, 0), adsk.core.Point3D.create(-6, -6, 0))
# Get the profile defined by the circle
prof = sketch.profiles.item(1)
# Create an extrusion input
extrudes = rootComp.features.extrudeFeatures
extInput = extrudes.createInput(prof, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)
# Define that the extent is a distance extent of 5 cm
distance = adsk.core.ValueInput.createByReal(5)
# Set the distance extent to be symmetric
extInput.setDistanceExtent(True, distance)
# Set the extrude to be a solid one
extInput.isSolid = True
# Create the extrusion
ext = extrudes.add(extInput)
# Get the body created by the extrusion
body = ext.bodies.item(0)
axes = rootComp.constructionAxes
axisInput = axes.createInput()
# Add by line
if design.designType == adsk.fusion.DesignTypes.DirectDesignType:
axisInput.setByLine(adsk.core.InfiniteLine3D.create(adsk.core.Point3D.create(0), adsk.core.Vector3D.create(1, 0, 0)))
axes.add(axisInput)
# Prepare reference data
circularFace = None
for face in body.faces:
geom = face.geometry
if geom.surfaceType == adsk.core.SurfaceTypes.CylinderSurfaceType:
circularFace = face
break
linearEdge = None
for edge in body.edges:
edgeGeom = edge.geometry
if edgeGeom.curveType == adsk.core.Curve3DTypes.Line3DCurveType:
linearEdge = edge
break
faceOne = linearEdge.faces.item(0)
faceTwo = linearEdge.faces.item(1)
vertexOne = faceOne.vertices.item(0)
vertexTwo = faceOne.vertices.item(1)
# Add by circularFace
axisInput.setByCircularFace(circularFace)
axes.add(axisInput)
# Add by perpendicular at point
axisInput.setByPerpendicularAtPoint(faceOne, vertexOne)
axes.add(axisInput)
# Add by two planes
axisInput.setByTwoPlanes(faceOne, faceTwo)
axes.add(axisInput)
# Add by two points
axisInput.setByTwoPoints(vertexOne, vertexTwo)
axes.add(axisInput)
# Add by edge
axisInput.setByEdge(linearEdge)
axes.add(axisInput)
# Add by normal to face at point
axisInput.setByNormalToFaceAtPoint(faceTwo, vertexOne)
axis = axes.add(axisInput)
# Get health state of the axis
health = axis.healthState
if health == adsk.fusion.FeatureHealthStates.WarningFeatureHealthState or health == adsk.fusion.FeatureHealthStates.ErrorFeatureHealthState:
message = axis.errorOrWarningMessage
except:
if ui:
ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))
#include <Core/Application/Application.h>
#include <Core/Application/Documents.h>
#include <Core/Application/Document.h>
#include <Core/Application/Product.h>
#include <Core/Application/ValueInput.h>
#include <Core/Geometry/Point3D.h>
#include <Core/Geometry/InfiniteLine3D.h>
#include <Core/Geometry/Line3D.h>
#include <Core/Geometry/Surface.h>
#include <Core/Geometry/Vector3D.h>
#include <Core/UserInterface/UserInterface.h>
#include <Fusion/BRep/BRepBody.h>
#include <Fusion/BRep/BRepBodies.h>
#include <Fusion/BRep/BRepEdge.h>
#include <Fusion/BRep/BRepEdges.h>
#include <Fusion/BRep/BRepFace.h>
#include <Fusion/BRep/BRepFaces.h>
#include <Fusion/BRep/BRepVertices.h>
#include <Fusion/BRep/BRepVertex.h>
#include <Fusion/Components/Component.h>
#include <Fusion/Construction/ConstructionAxes.h>
#include <Fusion/Construction/ConstructionAxis.h>
#include <Fusion/Construction/ConstructionAxisInput.h>
#include <Fusion/Construction/ConstructionPlane.h>
#include <Fusion/Features/Features.h>
#include <Fusion/Features/ExtrudeFeature.h>
#include <Fusion/Features/ExtrudeFeatures.h>
#include <Fusion/Features/ExtrudeFeatureInput.h>
#include <Fusion/Fusion/Design.h>
#include <Fusion/Sketch/Profile.h>
#include <Fusion/Sketch/Profiles.h>
#include <Fusion/Sketch/Sketch.h>
#include <Fusion/Sketch/Sketches.h>
#include <Fusion/Sketch/SketchCircle.h>
#include <Fusion/Sketch/SketchCircles.h>
#include <Fusion/Sketch/SketchCurves.h>
#include <Fusion/Sketch/SketchLine.h>
#include <Fusion/Sketch/SketchLines.h>
using namespace adsk::core;
using namespace adsk::fusion;
Ptr<UserInterface> ui;
extern "C" XI_EXPORT bool run(const char* context)
{
Ptr<Application> app = Application::get();
if (!app)
return false;
ui = app->userInterface();
if (!ui)
return false;
Ptr<Documents> documents = app->documents();
if (!documents)
return false;
Ptr<Document> doc = documents->add(DocumentTypes::FusionDesignDocumentType);
if (!doc)
return false;
Ptr<Product> product = app->activeProduct();
if (!product)
return false;
Ptr<Design> design = product;
if (!design)
return false;
// Get the root component of the active design
Ptr<Component> rootComp = design->rootComponent();
if (!rootComp)
return false;
// Create sketch
Ptr<Sketches> sketches = rootComp->sketches();
if (!sketches)
return false;
Ptr<ConstructionPlane> xz = rootComp->xZConstructionPlane();
if (!xz)
return false;
Ptr<Sketch> sketch = sketches->add(xz);
if (!sketch)
return false;
Ptr<SketchCurves> sketchCurves = sketch->sketchCurves();
if (!sketchCurves)
return false;
Ptr<SketchCircles> sketchCircles = sketchCurves->sketchCircles();
if (!sketchCircles)
return false;
Ptr<Point3D> centerPoint = Point3D::create(0, 0, 0);
if (!centerPoint)
return false;
Ptr<SketchCircle> circle = sketchCircles->addByCenterRadius(centerPoint, 5.0);
if (!circle)
return false;
Ptr<SketchLines> sketchLines = sketchCurves->sketchLines();
if (!sketchLines)
return false;
sketchLines->addTwoPointRectangle(Point3D::create(6, 6, 0), Point3D::create(-6, -6, 0));
// Get the profile defined by the circle
Ptr<Profiles> profs = sketch->profiles();
if (!profs)
return false;
Ptr<Profile> prof = profs->item(1);
if (!prof)
return false;
// Create an extrusion input
Ptr<Features> feats = rootComp->features();
if (!feats)
return false;
Ptr<ExtrudeFeatures> extrudes = feats->extrudeFeatures();
if (!extrudes)
return false;
Ptr<ExtrudeFeatureInput> extInput = extrudes->createInput(prof, FeatureOperations::NewBodyFeatureOperation);
if (!extInput)
return false;
// Define that the extent is a distance extent of 5 cm
Ptr<ValueInput> distance = ValueInput::createByReal(5);
if (!distance)
return false;
// Set the distance extent to be symmetric
extInput->setDistanceExtent(true, distance);
// Set the extrude to be a solid one
extInput->isSolid(true);
// Create the extrusion
Ptr<ExtrudeFeature> ext = extrudes->add(extInput);
if (!ext)
return false;
// Get the body created by the extrusion
Ptr<BRepBodies> bodies = ext->bodies();
if (!bodies)
return false;
Ptr<BRepBody> body = bodies->item(0);
if (!body)
return false;
Ptr<ConstructionAxes> axes = rootComp->constructionAxes();
if (!axes)
return false;
Ptr<ConstructionAxisInput> axisInput = axes->createInput();
if (!axisInput)
return false;
// Add by line
if (design->designType() == DesignTypes::DirectDesignType)
{
axisInput->setByLine(InfiniteLine3D::create(Point3D::create(0), Vector3D::create(1, 0, 0)));
axes->add(axisInput);
}
Ptr<BRepFaces> faces = body->faces();
if (!faces)
return false;
// Prepare reference data
Ptr<BRepFace> circularFace = nullptr;
for (auto face : faces)
{
Ptr<Surface> geom = face->geometry();
if (geom->surfaceType() == SurfaceTypes::CylinderSurfaceType)
{
circularFace = face;
break;
}
}
Ptr<BRepEdge> linearEdge = nullptr;
for (auto edge : body->edges())
{
Ptr<Curve3D> edgeGeom = edge->geometry();
if (edgeGeom->curveType() == Curve3DTypes::Line3DCurveType)
{
linearEdge = edge;
break;
}
}
Ptr<BRepFace> faceOne = faces->item(0);
if (!faceOne)
return false;
Ptr<BRepFace> faceTwo = faces->item(1);
if (!faceTwo)
return false;
Ptr<BRepVertices> vertices = faceOne->vertices();
if (!vertices)
return false;
Ptr<BRepVertex> vertexOne = vertices->item(0);
if (!vertexOne)
return false;
Ptr<BRepVertex> vertexTwo = vertices->item(1);
if (!vertexTwo)
return false;
// Add by circularFace
axisInput->setByCircularFace(circularFace);
axes->add(axisInput);
// Add by perpendicular at point
axisInput->setByPerpendicularAtPoint(faceOne, vertexOne);
axes->add(axisInput);
// Add by two planes
axisInput->setByTwoPlanes(faceOne, faceTwo);
axes->add(axisInput);
// Add by two points
axisInput->setByTwoPoints(vertexOne, vertexTwo);
axes->add(axisInput);
// Add by edge
axisInput->setByEdge(linearEdge);
axes->add(axisInput);
// Add by normal to face at point
axisInput->setByNormalToFaceAtPoint(faceTwo, vertexOne);
Ptr<ConstructionAxis> axis = axes->add(axisInput);
// Get the health state of a construction plane
adsk::fusion::FeatureHealthStates health = axis->healthState();
if (health == adsk::fusion::FeatureHealthStates::ErrorFeatureHealthState ||
health == adsk::fusion::FeatureHealthStates::WarningFeatureHealthState)
{
std::string msg = axis->errorOrWarningMessage();
}
return true;
}
#ifdef XI_WIN
#include <windows.h>
BOOL APIENTRY DllMain(HMODULE hmodule, DWORD reason, LPVOID reserved)
{
switch (reason)
{
case DLL_PROCESS_ATTACH:
case DLL_THREAD_ATTACH:
case DLL_THREAD_DETACH:
case DLL_PROCESS_DETACH:
break;
}
return TRUE;
}
#endif // XI_WIN