import adsk.core, adsk.fusion, traceback
def run(context):
ui = None
try:
app = adsk.core.Application.get()
ui = app.userInterface
# Create a document.
doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType)
product = app.activeProduct
design = adsk.fusion.Design.cast(product)
# Get the root component of the active design
rootComp = design.rootComponent
# Create sketch
sketches = rootComp.sketches
sketch = sketches.add(rootComp.xZConstructionPlane)
# Get sketch lines
sketchLines = sketch.sketchCurves.sketchLines
# Create sketch rectangle
startPoint = adsk.core.Point3D.create(0, 0, 0)
endPoint = adsk.core.Point3D.create(5.0, 5.0, 0)
sketchLines.addTwoPointRectangle(startPoint, endPoint)
# Get two sketch lines
sketchLineOne = sketchLines.item(0)
sketchLineTwo = sketchLines.item(1)
# Get the profile
prof = sketch.profiles.item(0)
# Create an extrusion input
extrudes = rootComp.features.extrudeFeatures
extInput = extrudes.createInput(prof, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)
# Define that the extent is a distance extent of 5 cm
distance = adsk.core.ValueInput.createByReal(5.0)
# Set the distance extent
extInput.setDistanceExtent(False, distance)
# Set the extrude type to be solid
extInput.isSolid = True
# Create the extrusion
ext = extrudes.add(extInput)
# Create a sketch circle
sketchCircles = sketch.sketchCurves.sketchCircles
centerPoint = adsk.core.Point3D.create(8, 8, 0)
sketchCircle = sketchCircles.addByCenterRadius(centerPoint, 3.0)
# Get the body with the extrude
body = ext.bodies.item(0)
# Get a vertex of the body
vertex = body.vertices.item(0)
# Get three intersect faces
faceOne = vertex.faces.item(0)
faceTwo = vertex.faces.item(1)
faceThree = vertex.faces.item(2)
# Create perpendicular construction axis
axes = rootComp.constructionAxes
axisInput = axes.createInput()
axisInput.setByPerpendicularAtPoint(faceOne, vertex)
axis = axes.add(axisInput)
# Get construction points
constructionPoints = rootComp.constructionPoints
# Create construction point input
pointInput = constructionPoints.createInput()
# Create construction point by two points
pointInput.setByTwoEdges(sketchLineOne, sketchLineTwo)
constructionPoints.add(pointInput)
# Create construction point by three planes
pointInput.setByThreePlanes(faceOne, faceTwo, faceThree)
constructionPoints.add(pointInput)
# Create construction point by edge and plane
pointInput.setByEdgePlane(axis, faceOne)
constructionPoints.add(pointInput)
# Create construction point by center
pointInput.setByCenter(sketchCircle)
constructionPoints.add(pointInput)
# Create construction point by point
pointInput.setByPoint(vertex)
point = constructionPoints.add(pointInput)
# Get the health state of the construction point
health = point.healthState
if health == adsk.fusion.FeatureHealthStates.ErrorFeatureHealthState or health == adsk.fusion.FeatureHealthStates.WarningFeatureHealthState:
message = point.errorOrWarningMessage
except:
if ui:
ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))
#include <Core/Application/Application.h>
#include <Core/Application/Document.h>
#include <Core/Application/Documents.h>
#include <Core/Geometry/Point3D.h>
#include <Core/Geometry/Vector3D.h>
#include <Core/UserInterface/UserInterface.h>
#include <Fusion/Components/Component.h>
#include <Fusion/Construction/ConstructionPlane.h>
#include <Fusion/Construction/ConstructionAxes.h>
#include <Fusion/Construction/ConstructionAxis.h>
#include <Fusion/Construction/ConstructionAxisInput.h>
#include <Fusion/Construction/ConstructionPoints.h>
#include <Fusion/Construction/ConstructionPointInput.h>
#include <Fusion/Construction/ConstructionPoint.h>
#include <Fusion/Fusion/Design.h>
#include <Fusion/Sketch/Sketch.h>
#include <Fusion/Sketch/Sketches.h>
#include <Fusion/Sketch/SketchPoints.h>
#include <Fusion/Sketch/SketchPoint.h>
#include <Fusion/Sketch/SketchCurves.h>
#include <Fusion/Sketch/SketchLines.h>
#include <Fusion/Sketch/SketchLine.h>
#include <Fusion/Sketch/SketchCircles.h>
#include <Fusion/Sketch/SketchCircle.h>
#include <Fusion/Sketch/Profiles.h>
#include <Fusion/Sketch/Profile.h>
#include <Fusion/Features/Features.h>
#include <Fusion/Features/ExtrudeFeatures.h>
#include <Fusion/Features/ExtrudeFeatureInput.h>
#include <Fusion/Features/ExtrudeFeature.h>
#include <Fusion/BRep/BRepBodies.h>
#include <Fusion/BRep/BRepBody.h>
#include <Fusion/BRep/BRepFaces.h>
#include <Fusion/BRep/BRepFace.h>
#include <Fusion/BRep/BRepVertices.h>
#include <Fusion/BRep/BRepVertex.h>
// startTest
#include "../../../TestUtils.h"
// endTest
using namespace adsk::core;
using namespace adsk::fusion;
Ptr<UserInterface> ui;
extern "C" XI_EXPORT bool run(const char* context)
{
Ptr<Application> app = Application::get();
if (!app)
return false;
ui = app->userInterface();
if (!ui)
return false;
Ptr<Documents> docs = app->documents();
if (!docs)
return false;
// Create a document.
Ptr<Document> doc = docs->add(DocumentTypes::FusionDesignDocumentType);
if (!doc)
return false;
Ptr<Design> design = app->activeProduct();
if (!design)
return false;
// Get the root component of the active design
Ptr<Component> rootComp = design->rootComponent();
if (!rootComp)
return false;
// Create sketch
Ptr<Sketches> sketches = rootComp->sketches();
if (!sketches)
return false;
Ptr<Sketch> sketch = sketches->add(rootComp->xYConstructionPlane());
if (!sketch)
return false;
// Get sketch lines
Ptr<SketchCurves> curves = sketch->sketchCurves();
if (!curves)
return false;
Ptr<SketchLines> sketchLines = curves->sketchLines();
if (!sketchLines)
return false;
// Create sketch rectangle
Ptr<Point3D> startPoint = Point3D::create(0, 0, 0);
Ptr<Point3D> endPoint = Point3D::create(5.0, 5.0, 0);
sketchLines->addTwoPointRectangle(startPoint, endPoint);
// Get two sketch lines
Ptr<SketchLine> sketchLineOne = sketchLines->item(0);
Ptr<SketchLine> sketchLineTwo = sketchLines->item(1);
// Get the profile
Ptr<Profiles> profs = sketch->profiles();
if (!profs)
return false;
Ptr<Profile> prof = profs->item(0);
// Create an extrusion input
Ptr<Features> feats = rootComp->features();
if (!feats)
return false;
Ptr<ExtrudeFeatures> extrudes = feats->extrudeFeatures();
if (!extrudes)
return false;
Ptr<ExtrudeFeatureInput> extInput = extrudes->createInput(prof, FeatureOperations::NewBodyFeatureOperation);
// Define that the extent is a distance extent of 5 cm
Ptr<ValueInput> distance = ValueInput::createByReal(5.0);
// Set the distance extent
extInput->setDistanceExtent(false, distance);
// Set the extrude type to be solid
extInput->isSolid(true);
// Create the extrusion
Ptr<ExtrudeFeature> ext = extrudes->add(extInput);
if (!ext)
return false;
// Create a sketch circle
Ptr<SketchCircles> sketchCircles = curves->sketchCircles();
if (!sketchCircles)
return false;
Ptr<Point3D> centerPoint = Point3D::create(8.0, 8.0, 0);
Ptr<SketchCircle> sketchCircle = sketchCircles->addByCenterRadius(centerPoint, 3.0);
// Get the body with the extrude
Ptr<BRepBodies> bodies = ext->bodies();
if (!bodies)
return false;
Ptr<BRepBody> body = bodies->item(0);
// Get a vertex of the body
Ptr<BRepVertices> vertices = body->vertices();
if (!vertices)
return false;
Ptr<BRepVertex> vertex = vertices->item(0);
// Get three intersect faces
Ptr<BRepFaces> vertexFaces = vertex->faces();
if (!vertexFaces)
return false;
Ptr<BRepFace> faceOne = vertexFaces->item(0);
Ptr<BRepFace> faceTwo = vertexFaces->item(1);
Ptr<BRepFace> faceThree = vertexFaces->item(2);
// Create perpendicular construction axis
Ptr<ConstructionAxes> axes = rootComp->constructionAxes();
if (!axes)
return false;
Ptr<ConstructionAxisInput> axisInput = axes->createInput();
if (!axisInput)
return false;
axisInput->setByPerpendicularAtPoint(faceOne, vertex);
Ptr<ConstructionAxis> axis = axes->add(axisInput);
// Get construction points
Ptr<ConstructionPoints> constructionPoints = rootComp->constructionPoints();
if (!constructionPoints)
return false;
// Create construction point input
Ptr<ConstructionPointInput> pointInput = constructionPoints->createInput();
if (!pointInput)
return false;
// Create construction point by two points
pointInput->setByTwoEdges(sketchLineOne, sketchLineTwo);
constructionPoints->add(pointInput);
// Create construction point by three planes
pointInput->setByThreePlanes(faceOne, faceTwo, faceThree);
constructionPoints->add(pointInput);
// Create construction point by edge and plane
pointInput->setByEdgePlane(axis, faceOne);
constructionPoints->add(pointInput);
// Create construction point by center
pointInput->setByCenter(sketchCircle);
constructionPoints->add(pointInput);
// Create construction point by point
pointInput->setByPoint(vertex);
Ptr<ConstructionPoint> point = constructionPoints->add(pointInput);
// Get health state of a construction point
adsk::fusion::FeatureHealthStates health = point->healthState();
if (health == adsk::fusion::FeatureHealthStates::ErrorFeatureHealthState ||
health == adsk::fusion::FeatureHealthStates::WarningFeatureHealthState)
{
std::string msg = point->errorOrWarningMessage();
}
// startTest
doc->close(false);
// endTest
return true;
}
#ifdef XI_WIN
#include <windows.h>
BOOL APIENTRY DllMain(HMODULE hmodule, DWORD reason, LPVOID reserved)
{
switch (reason)
{
case DLL_PROCESS_ATTACH:
case DLL_THREAD_ATTACH:
case DLL_THREAD_DETACH:
case DLL_PROCESS_DETACH:
break;
}
return TRUE;
}
#endif // XI_WIN