#Author- #Description- import adsk.core, adsk.fusion, traceback def run(context): ui = None try: app = adsk.core.Application.get() ui = app.userInterface # Create a document. doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType) product = app.activeProduct design = adsk.fusion.Design.cast(product) # Get the root component of the active design rootComp = design.rootComponent # Create sketch in root component sketches = rootComp.sketches sketch = sketches.add(rootComp.xZConstructionPlane) sketchPts = sketch.sketchPoints point = adsk.core.Point3D.create(1, 0, 1) sketchPt = sketchPts.add(point) sketchLines = sketch.sketchCurves.sketchLines point1 = adsk.core.Point3D.create(1, 0, 2) point2 = adsk.core.Point3D.create(2, 0, 1) point1SketchSpace = sketch.modelToSketchSpace(point1) point2SketchSpace = sketch.modelToSketchSpace(point2) lines = sketchLines.addTwoPointRectangle(point1SketchSpace, point2SketchSpace) # Get the profile defined by the circle prof = sketch.profiles.item(0) # Create an extrusion input and make sure it's in a new component extrudes = rootComp.features.extrudeFeatures extInput = extrudes.createInput(prof, adsk.fusion.FeatureOperations.NewComponentFeatureOperation) # Set the extrusion input distance = adsk.core.ValueInput.createByReal(5) extInput.setDistanceExtent(True, distance) extInput.isSolid = True # Create the extrusion ext = extrudes.add(extInput) # Get the end face of the created extrusion body endFace = ext.endFaces.item(0) # Get the occurrence of the new component occ = rootComp.occurrences.item(0) # Create a new sketch in the occurrence sketchInOcc = sketches.add(endFace, occ) # Get the sketch curve projected to the sketch curve = sketchInOcc.sketchCurves.item(0) # Create the first joint geometry with the sketch curve geo0 = adsk.fusion.JointGeometry.createByCurve(curve, adsk.fusion.JointKeyPointTypes.StartKeyPoint) # Create the second joint geometry with sketch point geo1 = adsk.fusion.JointGeometry.createByPoint(sketchPt) # Create joint input joints = rootComp.joints jointInput = joints.createInput(geo0, geo1) # Set the joint input jointInput.setAsCylindricalJointMotion(adsk.fusion.JointDirections.CustomJointDirection, curve.createForAssemblyContext(occ)) # Create the joint joint = joints.add(jointInput) cylindricalMotion = joint.jointMotion rotLimits = cylindricalMotion.rotationLimits rotLimits.isRestValueEnabled = True rotLimits.restValue = 3.14 / 3 slideLimits = cylindricalMotion.slideLimits slideLimits.isMinimumValueEnabled = True slideLimits.minimumValue = 0.1 except: if ui: ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))
#include <Core/Application/Application.h> #include <Core/Application/Documents.h> #include <Core/Application/Document.h> #include <Core/Application/Product.h> #include <Core/Application/ValueInput.h> #include <Core/Geometry/Point3D.h> #include <Core/UserInterface/UserInterface.h> #include <Fusion/BRep/BRepFace.h> #include <Fusion/BRep/BRepFaces.h> #include <Fusion/Components/Component.h> #include <Fusion/Components/Joint.h> #include <Fusion/Components/JointGeometry.h> #include <Fusion/Components/JointInput.h> #include <Fusion/Components/JointLimits.h> #include <Fusion/Components/Joints.h> #include <Fusion/Components/CylindricalJointMotion.h> #include <Fusion/Components/Occurrence.h> #include <Fusion/Components/Occurrences.h> #include <Fusion/Construction/ConstructionPlane.h> #include <Fusion/Features/Features.h> #include <Fusion/Features/ExtrudeFeature.h> #include <Fusion/Features/ExtrudeFeatures.h> #include <Fusion/Features/ExtrudeFeatureInput.h> #include <Fusion/Fusion/Design.h> #include <Fusion/Sketch/Profile.h> #include <Fusion/Sketch/Profiles.h> #include <Fusion/Sketch/Sketch.h> #include <Fusion/Sketch/Sketches.h> #include <Fusion/Sketch/SketchCircle.h> #include <Fusion/Sketch/SketchCircles.h> #include <Fusion/Sketch/SketchCurve.h> #include <Fusion/Sketch/SketchCurves.h> #include <Fusion/Sketch/SketchLine.h> #include <Fusion/Sketch/SketchLines.h> #include <Fusion/Sketch/SketchLineList.h> #include <Fusion/Sketch/SketchPoint.h> #include <Fusion/Sketch/SketchPoints.h> // startTest #include "../../../TestUtils.h" // endTest using namespace adsk::core; using namespace adsk::fusion; Ptr<UserInterface> ui; extern "C" XI_EXPORT bool run(const char* context) { Ptr<Application> app = Application::get(); if (!app) return false; ui = app->userInterface(); if (!ui) return false; Ptr<Documents> documents = app->documents(); if (!documents) return false; Ptr<Document> doc = documents->add(DocumentTypes::FusionDesignDocumentType); if (!doc) return false; Ptr<Product> product = app->activeProduct(); if (!product) return false; Ptr<Design> design = product; if (!design) return false; // Get the root component of the active design Ptr<Component> rootComp = design->rootComponent(); if (!rootComp) return false; // Create sketch in root component Ptr<Sketches> sketches = rootComp->sketches(); if (!sketches) return false; Ptr<ConstructionPlane> xz = rootComp->xZConstructionPlane(); if (!xz) return false; Ptr<Sketch> sketch = sketches->add(xz); if (!sketch) return false; Ptr<SketchCurves> sketchCurves = sketch->sketchCurves(); if (!sketchCurves) return false; Ptr<SketchPoints> sketchPts = sketch->sketchPoints(); if (!sketchPts) return false; Ptr<Point3D> point = Point3D::create(1, 0, 1); if (!point) return false; Ptr<SketchPoint> sketchPt = sketchPts->add(point); if (!sketchPt) return false; Ptr<SketchLines> sketchLines = sketchCurves->sketchLines(); if (!sketchLines) return false; Ptr<Point3D> point1 = Point3D::create(1, 0, 2); if (!point1) return false; Ptr<Point3D> point2 = Point3D::create(2, 0, 1); if (!point2) return false; Ptr<Point3D> point1SketchSpace = sketch->modelToSketchSpace(point1); if (!point1SketchSpace) return false; Ptr<Point3D> point2SketchSpace = sketch->modelToSketchSpace(point2); if (!point2SketchSpace) return false; Ptr<SketchLineList> lines = sketchLines->addTwoPointRectangle(point1SketchSpace, point2SketchSpace); if (!lines) return false; // Get the profile defined by the circle Ptr<Profiles> profs = sketch->profiles(); if (!profs) return false; Ptr<Profile> prof = profs->item(0); if (!prof) return false; // Create an extrusion input and make sure it's in a new component Ptr<Features> feats = rootComp->features(); if (!feats) return false; Ptr<ExtrudeFeatures> extrudes = feats->extrudeFeatures(); if (!extrudes) return false; Ptr<ExtrudeFeatureInput> extInput = extrudes->createInput(prof, FeatureOperations::NewComponentFeatureOperation); if (!extInput) return false; // Set the extrusion input Ptr<ValueInput> distance = ValueInput::createByReal(5); if (!distance) return false; extInput->setDistanceExtent(true, distance); extInput->isSolid(true); // Create the extrusion Ptr<ExtrudeFeature> ext = extrudes->add(extInput); if (!ext) return false; // Get the end face of the created extrusion body Ptr<BRepFaces> endFaces = ext->endFaces(); if (!endFaces) return false; Ptr<BRepFace> endFace = endFaces->item(0); if (!endFace) return false; // Get the occurrence of the new component Ptr<Occurrences> occs = rootComp->occurrences(); if (!occs) return false; Ptr<Occurrence> occ = occs->item(0); if (!occ) return false; // Create a new sketch in the occurrence Ptr<Sketch> sketchInOcc = sketches->add(endFace, occ); if (!sketchInOcc) return false; // Get the sketch curve projected to the sketch Ptr<SketchCurves> sketchCurvesInOcc = sketchInOcc->sketchCurves(); if (!sketchCurvesInOcc) return false; Ptr<SketchCurve> curve = sketchCurvesInOcc->item(0); if (!curve) return false; // Create the first joint geometry with the sketch curve Ptr<JointGeometry> geo0 = JointGeometry::createByCurve(curve, JointKeyPointTypes::StartKeyPoint); if (!geo0) return false; // Create the second joint geometry with sketch point Ptr<JointGeometry> geo1 = JointGeometry::createByPoint(sketchPt); if (!geo1) return false; // Create joint input Ptr<Joints> joints = rootComp->joints(); if (!joints) return false; Ptr<JointInput> jointInput = joints->createInput(geo0, geo1); if (!jointInput) return false; // Set the joint input Ptr<SketchLine> line = curve->cast<SketchLine>(); if (!line) return false; Ptr<SketchLine> lineProxy = line->createForAssemblyContext(occ); if (!lineProxy) return false; jointInput->setAsCylindricalJointMotion(JointDirections::CustomJointDirection, lineProxy); // Create the joint Ptr<Joint> joint = joints->add(jointInput); if (!joint) return false; Ptr<CylindricalJointMotion> cylindricalMotion = joint->jointMotion(); if (!cylindricalMotion) return false; Ptr<JointLimits> rotLimits = cylindricalMotion->rotationLimits(); if (!rotLimits) return false; rotLimits->isRestValueEnabled(true); rotLimits->restValue(3.14 / 3); Ptr<JointLimits> slideLimits = cylindricalMotion->slideLimits(); if (!slideLimits) return false; slideLimits->isMinimumValueEnabled(true); slideLimits->minimumValue(0.1); // startTest doc->close(false); // endTest return true; } #ifdef XI_WIN #include <windows.h> BOOL APIENTRY DllMain(HMODULE hmodule, DWORD reason, LPVOID reserved) { switch (reason) { case DLL_PROCESS_ATTACH: case DLL_THREAD_ATTACH: case DLL_THREAD_DETACH: case DLL_PROCESS_DETACH: break; } return TRUE; } #endif // XI_WIN