import adsk.core, adsk.fusion, traceback
def run(context):
ui = None
try:
app = adsk.core.Application.get()
ui = app.userInterface
# Create a document.
doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType)
product = app.activeProduct
design = adsk.fusion.Design.cast(product)
design.designType = adsk.fusion.DesignTypes.DirectDesignType
# Get the root component of the active design.
rootComp = design.rootComponent
features = rootComp.features
# Create sketch circle on the xz plane.
sketches = rootComp.sketches
sketch = sketches.add(rootComp.xZConstructionPlane)
sketchCircles = sketch.sketchCurves.sketchCircles
centerPoint = adsk.core.Point3D.create(0, 0, 0)
sketchCircles.addByCenterRadius(centerPoint, 10)
# Create a collection of entities for extrude
entities0 = adsk.core.ObjectCollection.create()
entities0.add(sketch.profiles.item(0))
# Create a cylinder with ExtrudeFeature using the profile above.
extrudeFeats = features.extrudeFeatures
extrudeFeatureInput = extrudeFeats.createInput(entities0, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)
extrudeFeatureInput.isSolid = True
extrudeFeatureInput.setDistanceExtent(False, adsk.core.ValueInput.createByReal(2.5))
extrudeFeature = extrudeFeats.add(extrudeFeatureInput)
# Create second body to do interference
sketch = sketches.add(rootComp.xZConstructionPlane)
sketchCircles = sketch.sketchCurves.sketchCircles
centerPoint = adsk.core.Point3D.create(5, 0, 0)
sketchCircles.addByCenterRadius(centerPoint, 10)
entities0.clear()
entities0.add(sketch.profiles.item(0))
# Create a cylinder with ExtrudeFeature using the profile above.
extrudeFeatureInput = extrudeFeats.createInput(entities0, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)
extrudeFeatureInput.isSolid = True
extrudeFeatureInput.setDistanceExtent(False, adsk.core.ValueInput.createByReal(2.5))
extrudeFeature = extrudeFeats.add(extrudeFeatureInput)
# Create a collection of bodies
bodies = adsk.core.ObjectCollection.create()
for body in rootComp.bRepBodies:
bodies.add(body)
# Create InterferenceInput
input = design.createInterferenceInput(bodies)
# Analyze interference
results = design.analyzeInterference(input)
# Create bodies
results.createBodies(True)
except:
if ui:
ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))
#include <Core/Application/Application.h>
#include <Core/Application/Documents.h>
#include <Core/Application/Document.h>
#include <Core/Application/Product.h>
#include <Core/Application/ObjectCollection.h>
#include <Core/Application/ValueInput.h>
#include <Core/Geometry/Point3D.h>
#include <Core/UserInterface/UserInterface.h>
#include <Fusion/BRep/BRepBodies.h>
#include <Fusion/BRep/BRepBody.h>
#include <Fusion/Sketch/SketchCircle.h>
#include <Fusion/Fusion/Design.h>
#include <Fusion/Fusion/InterferenceResult.h>
#include <Fusion/Fusion/InterferenceResults.h>
#include <Fusion/Components/Component.h>
#include <Fusion/Construction/ConstructionPlanes.h>
#include <Fusion/Construction/ConstructionPlane.h>
#include <Fusion/Construction/ConstructionPlaneInput.h>
#include <Fusion/Features/Features.h>
#include <Fusion/Features/ExtrudeFeature.h>
#include <Fusion/Features/ExtrudeFeatures.h>
#include <Fusion/Features/ExtrudeFeatureInput.h>
#include <Fusion/Sketch/Profile.h>
#include <Fusion/Sketch/Profiles.h>
#include <Fusion/Sketch/Sketch.h>
#include <Fusion/Sketch/Sketches.h>
#include <Fusion/Sketch/SketchCurves.h>
#include <Fusion/Sketch/SketchCircles.h>
#include <Fusion/Sketch/SketchPoint.h>
#include <Fusion/Sketch/SketchPoints.h>
using namespace adsk::core;
using namespace adsk::fusion;
Ptr<UserInterface> ui;
extern "C" XI_EXPORT bool run(const char* context)
{
Ptr<Application> app = Application::get();
if (!app)
return false;
ui = app->userInterface();
if (!ui)
return false;
Ptr<Documents> documents = app->documents();
if (!documents)
return false;
Ptr<Document> doc = documents->add(DocumentTypes::FusionDesignDocumentType);
if (!doc)
return false;
Ptr<Product> product = app->activeProduct();
if (!product)
return false;
Ptr<Design> design = product;
if (!design)
return false;
bool res = design->designType(DirectDesignType);
if (!res)
return false;
// Get the root component of the active design
Ptr<Component> rootComp = design->rootComponent();
if (!rootComp)
return false;
// Create sketch circle on the xz plane.
Ptr<Sketches> sketches = rootComp->sketches();
if (!sketches)
return false;
Ptr<Sketch> sketch = sketches->add(rootComp->xZConstructionPlane());
if (!sketch)
return false;
Ptr<SketchCurves> sketchCurves = sketch->sketchCurves();
if (!sketchCurves)
return false;
Ptr<SketchCircles> sketchCirles = sketchCurves->sketchCircles();
if (!sketchCirles)
return false;
Ptr<Point3D> centerPoint = Point3D::create(0, 0, 0);
if (!centerPoint)
return false;
Ptr<SketchCircle> sketchCircle = sketchCirles->addByCenterRadius(centerPoint, 10);
if (!sketchCircle)
return false;
// Create a collection of entities for extrude
Ptr<ObjectCollection> entities0 = ObjectCollection::create();
if (!entities0)
return false;
Ptr<Profiles> sketchProfiles = sketch->profiles();
if (!sketchProfiles)
return false;
Ptr<Profile> sketchProfile = sketchProfiles->item(0);
if (!sketchProfile)
return false;
entities0->add(sketchProfile);
// Create a cylinder with ExtrudeFeature using the profile above.
Ptr<Features> features = rootComp->features();
if (!features)
return false;
Ptr<ExtrudeFeatures> extrudeFeats = features->extrudeFeatures();
if (!extrudeFeats)
return false;
Ptr<ExtrudeFeatureInput> extrudeFeatureInput =
extrudeFeats->createInput(entities0, adsk::fusion::FeatureOperations::NewBodyFeatureOperation);
if (!extrudeFeatureInput)
return false;
Ptr<ValueInput> distance = adsk::core::ValueInput::createByReal(2.0);
if (!distance)
return false;
extrudeFeatureInput->isSolid(true);
extrudeFeatureInput->setDistanceExtent(false, distance);
Ptr<ExtrudeFeature> extrudeFeature = extrudeFeats->add(extrudeFeatureInput);
if (!extrudeFeature)
return false;
// Create second body to do interference
sketch = sketches->add(rootComp->xZConstructionPlane());
if (!sketch)
return false;
sketchCurves = sketch->sketchCurves();
if (!sketchCurves)
return false;
sketchCirles = sketchCurves->sketchCircles();
if (!sketchCirles)
return false;
centerPoint = Point3D::create(5, 0, 0);
if (!centerPoint)
return false;
sketchCircle = sketchCirles->addByCenterRadius(centerPoint, 10);
if (!sketchCircle)
return false;
entities0->clear();
sketchProfiles = sketch->profiles();
if (!sketchProfiles)
return false;
sketchProfile = sketchProfiles->item(0);
if (!sketchProfile)
return false;
entities0->add(sketchProfile);
// Create a cylinder with ExtrudeFeature using the profile above.
extrudeFeatureInput =
extrudeFeats->createInput(entities0, adsk::fusion::FeatureOperations::NewBodyFeatureOperation);
if (!extrudeFeatureInput)
return false;
distance = adsk::core::ValueInput::createByReal(2.0);
if (!distance)
return false;
extrudeFeatureInput->isSolid(true);
extrudeFeatureInput->setDistanceExtent(false, distance);
extrudeFeature = extrudeFeats->add(extrudeFeatureInput);
if (!extrudeFeature)
return false;
// Create a collection of bodies
Ptr<ObjectCollection> bodies = adsk::core::ObjectCollection::create();
if (!bodies)
return false;
Ptr<BRepBodies> brepBodies = rootComp->bRepBodies();
if (!brepBodies)
return false;
for (auto body : brepBodies)
{
bodies->add(body);
}
// Create InterferenceInput
Ptr<InterferenceInput> input = design->createInterferenceInput(bodies);
if (!input)
return false;
// Analyze interference
Ptr<InterferenceResults> results = design->analyzeInterference(input);
if (!input)
return false;
// Create bodies
results->createBodies(true);
return true;
}
#ifdef XI_WIN
#include <windows.h>
BOOL APIENTRY DllMain(HMODULE hmodule, DWORD reason, LPVOID reserved)
{
switch (reason)
{
case DLL_PROCESS_ATTACH:
case DLL_THREAD_ATTACH:
case DLL_THREAD_DETACH:
case DLL_PROCESS_DETACH:
break;
}
return TRUE;
}
#endif // XI_WIN