#Author- #Description- import adsk.core, adsk.fusion, traceback def run(context): ui = None try: app = adsk.core.Application.get() ui = app.userInterface # Create a document. doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType) product = app.activeProduct design = adsk.fusion.Design.cast(product) # Get the root component of the active design rootComp = design.rootComponent # Create sketch in root component sketches = rootComp.sketches sketch = sketches.add(rootComp.xZConstructionPlane) sketchCircles = sketch.sketchCurves.sketchCircles centerPoint0 = adsk.core.Point3D.create(0, 0, 0) circle0 = sketchCircles.addByCenterRadius(centerPoint0, 5.0) centerPoint1 = adsk.core.Point3D.create(10, 10, 0) circle1 = sketchCircles.addByCenterRadius(centerPoint1, 5.0) # Get the profile defined by the circle prof0 = sketch.profiles.item(0) prof1 = sketch.profiles.item(1) # Create an extrusion input and make sure it's in a new component extrudes = rootComp.features.extrudeFeatures extInput = extrudes.createInput(prof0, adsk.fusion.FeatureOperations.NewComponentFeatureOperation) # Set the extrusion input distance = adsk.core.ValueInput.createByReal(5) extInput.setDistanceExtent(True, distance) extInput.isSolid = True # Create the extrusion ext = extrudes.add(extInput) # Get the side face of the created extrusion body sideFace = ext.sideFaces.item(0) # Create the first joint geometry with the side face geo0 = adsk.fusion.JointGeometry.createByNonPlanarFace(sideFace, adsk.fusion.JointKeyPointTypes.StartKeyPoint) # Create the second joint geometry with prof1 geo1 = adsk.fusion.JointGeometry.createByProfile(prof1, circle1, adsk.fusion.JointKeyPointTypes.CenterKeyPoint) # Create joint input joints = rootComp.joints jointInput = joints.createInput(geo0, geo1) # Set the joint input angle = adsk.core.ValueInput.createByString('90 deg') jointInput.angle = angle offset = adsk.core.ValueInput.createByString('1 cm') jointInput.offset = offset jointInput.isFlipped = True jointInput.setAsRevoluteJointMotion(adsk.fusion.JointDirections.YAxisJointDirection) # Create the joint joint = joints.add(jointInput) revoluteMotion = joint.jointMotion limits = revoluteMotion.rotationLimits limits.isMinimumValueEnabled = True limits.minimumValue = 3.14 / 3 limits.isMaximumValueEnabled = True limits.maximumValue = 3.14 / 3 * 2 except: if ui: ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))
#include <Core/Application/Application.h> #include <Core/Application/Documents.h> #include <Core/Application/Document.h> #include <Core/Application/Product.h> #include <Core/Application/ValueInput.h> #include <Core/Geometry/Point3D.h> #include <Core/UserInterface/UserInterface.h> #include <Fusion/BRep/BRepFace.h> #include <Fusion/BRep/BRepFaces.h> #include <Fusion/Components/Component.h> #include <Fusion/Components/Joint.h> #include <Fusion/Components/JointGeometry.h> #include <Fusion/Components/JointInput.h> #include <Fusion/Components/JointLimits.h> #include <Fusion/Components/Joints.h> #include <Fusion/Components/RevoluteJointMotion.h> #include <Fusion/Construction/ConstructionPlane.h> #include <Fusion/Features/Features.h> #include <Fusion/Features/ExtrudeFeature.h> #include <Fusion/Features/ExtrudeFeatures.h> #include <Fusion/Features/ExtrudeFeatureInput.h> #include <Fusion/Fusion/Design.h> #include <Fusion/Sketch/Profile.h> #include <Fusion/Sketch/Profiles.h> #include <Fusion/Sketch/Sketch.h> #include <Fusion/Sketch/Sketches.h> #include <Fusion/Sketch/SketchCircle.h> #include <Fusion/Sketch/SketchCircles.h> #include <Fusion/Sketch/SketchCurves.h> // startTest #include "../../../TestUtils.h" // endTest using namespace adsk::core; using namespace adsk::fusion; Ptr<UserInterface> ui; extern "C" XI_EXPORT bool run(const char* context) { Ptr<Application> app = Application::get(); if (!app) return false; ui = app->userInterface(); if (!ui) return false; Ptr<Documents> documents = app->documents(); if (!documents) return false; Ptr<Document> doc = documents->add(DocumentTypes::FusionDesignDocumentType); if (!doc) return false; Ptr<Product> product = app->activeProduct(); if (!product) return false; Ptr<Design> design = product; if (!design) return false; // Get the root component of the active design Ptr<Component> rootComp = design->rootComponent(); if (!rootComp) return false; // Create sketch in root component Ptr<Sketches> sketches = rootComp->sketches(); if (!sketches) return false; Ptr<ConstructionPlane> xz = rootComp->xZConstructionPlane(); if (!xz) return false; Ptr<Sketch> sketch = sketches->add(xz); if (!sketch) return false; Ptr<SketchCurves> sketchCurves = sketch->sketchCurves(); if (!sketchCurves) return false; Ptr<SketchCircles> sketchCircles = sketchCurves->sketchCircles(); if (!sketchCircles) return false; Ptr<Point3D> centerPoint0 = Point3D::create(0, 0, 0); if (!centerPoint0) return false; Ptr<SketchCircle> circle0 = sketchCircles->addByCenterRadius(centerPoint0, 5.0); if (!circle0) return false; Ptr<Point3D> centerPoint1 = Point3D::create(10, 10, 0); if (!centerPoint1) return false; Ptr<SketchCircle> circle1 = sketchCircles->addByCenterRadius(centerPoint1, 5.0); if (!circle1) return false; // Get the profile defined by the circle Ptr<Profiles> profs = sketch->profiles(); if (!profs) return false; Ptr<Profile> prof0 = profs->item(0); if (!prof0) return false; Ptr<Profile> prof1 = profs->item(1); if (!prof1) return false; // Create an extrusion input and make sure it's in a new component Ptr<Features> feats = rootComp->features(); if (!feats) return false; Ptr<ExtrudeFeatures> extrudes = feats->extrudeFeatures(); if (!extrudes) return false; Ptr<ExtrudeFeatureInput> extInput = extrudes->createInput(prof0, FeatureOperations::NewComponentFeatureOperation); if (!extInput) return false; // Set the extrusion input Ptr<ValueInput> distance = ValueInput::createByReal(5); if (!distance) return false; extInput->setDistanceExtent(true, distance); extInput->isSolid(true); // Create the extrusion Ptr<ExtrudeFeature> ext = extrudes->add(extInput); if (!ext) return false; // Get the side face of the created extrusion body Ptr<BRepFaces> sideFaces = ext->sideFaces(); if (!sideFaces) return false; Ptr<BRepFace> sideFace = sideFaces->item(0); if (!sideFace) return false; // Create the first joint geometry with the side face Ptr<JointGeometry> geo0 = JointGeometry::createByNonPlanarFace(sideFace, JointKeyPointTypes::StartKeyPoint); if (!geo0) return false; // Create the second joint geometry with prof1 Ptr<JointGeometry> geo1 = JointGeometry::createByProfile(prof1, circle1, JointKeyPointTypes::CenterKeyPoint); if (!geo1) return false; // Create joint input Ptr<Joints> joints = rootComp->joints(); if (!joints) return false; Ptr<JointInput> jointInput = joints->createInput(geo0, geo1); if (!jointInput) return false; // Set the joint input Ptr<ValueInput> angle = ValueInput::createByString("90 deg"); if (!angle) return false; jointInput->angle(angle); Ptr<ValueInput> offset = ValueInput::createByString("1 cm"); if (!offset) return false; jointInput->offset(offset); jointInput->isFlipped(true); jointInput->setAsRevoluteJointMotion(JointDirections::YAxisJointDirection); // Create the joint Ptr<Joint> joint = joints->add(jointInput); if (!joint) return false; Ptr<RevoluteJointMotion> revoluteMotion = joint->jointMotion(); if (!revoluteMotion) return false; Ptr<JointLimits> limits = revoluteMotion->rotationLimits(); if (!limits) return false; limits->isMinimumValueEnabled(true); limits->minimumValue(3.14 / 3); limits->isMaximumValueEnabled(true); limits->maximumValue(3.14 / 3 * 2); // startTest doc->close(false); // endTest return true; } #ifdef XI_WIN #include <windows.h> BOOL APIENTRY DllMain(HMODULE hmodule, DWORD reason, LPVOID reserved) { switch (reason) { case DLL_PROCESS_ATTACH: case DLL_THREAD_ATTACH: case DLL_THREAD_DETACH: case DLL_PROCESS_DETACH: break; } return TRUE; } #endif // XI_WIN