Demonstrates creating a joint with revolute joint motion.
Before running: No open document is required; the script creates a new design (or additional documents) as it runs.
#Author- #Description- import adsk.core, adsk.fusion, traceback def run(context): ui = None try: app = adsk.core.Application.get() ui = app.userInterface # Create a document. doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType) product = app.activeProduct design = adsk.fusion.Design.cast(product) # Get the root component of the active design rootComp = design.rootComponent # Create sketch in root component sketches = rootComp.sketches sketch = sketches.add(rootComp.xZConstructionPlane) sketchCircles = sketch.sketchCurves.sketchCircles centerPoint0 = adsk.core.Point3D.create(0, 0, 0) circle0 = sketchCircles.addByCenterRadius(centerPoint0, 5.0) centerPoint1 = adsk.core.Point3D.create(10, 10, 0) circle1 = sketchCircles.addByCenterRadius(centerPoint1, 5.0) # Get the profile defined by the circle prof0 = sketch.profiles.item(0) prof1 = sketch.profiles.item(1) # Create an extrusion input and make sure it's in a new component extrudes = rootComp.features.extrudeFeatures extInput = extrudes.createInput(prof0, adsk.fusion.FeatureOperations.NewComponentFeatureOperation) # Set the extrusion input distance = adsk.core.ValueInput.createByReal(5) extInput.setDistanceExtent(True, distance) extInput.isSolid = True # Create the extrusion ext = extrudes.add(extInput) # Get the side face of the created extrusion body sideFace = ext.sideFaces.item(0) # Create the first joint geometry with the side face geo0 = adsk.fusion.JointGeometry.createByNonPlanarFace(sideFace, adsk.fusion.JointKeyPointTypes.StartKeyPoint) # Create the second joint geometry with prof1 geo1 = adsk.fusion.JointGeometry.createByProfile(prof1, circle1, adsk.fusion.JointKeyPointTypes.CenterKeyPoint) # Create joint input joints = rootComp.joints jointInput = joints.createInput(geo0, geo1) # Set the joint input angle = adsk.core.ValueInput.createByString('90 deg') jointInput.angle = angle offset = adsk.core.ValueInput.createByString('1 cm') jointInput.offset = offset jointInput.isFlipped = True jointInput.setAsRevoluteJointMotion(adsk.fusion.JointDirections.YAxisJointDirection) # Create the joint joint = joints.add(jointInput) revoluteMotion = joint.jointMotion limits = revoluteMotion.rotationLimits limits.isMinimumValueEnabled = True limits.minimumValue = 3.14 / 3 limits.isMaximumValueEnabled = True limits.maximumValue = 3.14 / 3 * 2 except: if ui: ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))
#include <Core/Application/Application.h>
#include <Core/Application/Documents.h>
#include <Core/Application/Document.h>
#include <Core/Application/Product.h>
#include <Core/Application/ValueInput.h>
#include <Core/Geometry/Point3D.h>
#include <Core/UserInterface/UserInterface.h>
#include <Fusion/BRep/BRepFace.h>
#include <Fusion/BRep/BRepFaces.h>
#include <Fusion/Components/Component.h>
#include <Fusion/Components/Joint.h>
#include <Fusion/Components/JointGeometry.h>
#include <Fusion/Components/JointInput.h>
#include <Fusion/Components/JointLimits.h>
#include <Fusion/Components/Joints.h>
#include <Fusion/Components/RevoluteJointMotion.h>
#include <Fusion/Construction/ConstructionPlane.h>
#include <Fusion/Features/Features.h>
#include <Fusion/Features/ExtrudeFeature.h>
#include <Fusion/Features/ExtrudeFeatures.h>
#include <Fusion/Features/ExtrudeFeatureInput.h>
#include <Fusion/Fusion/Design.h>
#include <Fusion/Sketch/Profile.h>
#include <Fusion/Sketch/Profiles.h>
#include <Fusion/Sketch/Sketch.h>
#include <Fusion/Sketch/Sketches.h>
#include <Fusion/Sketch/SketchCircle.h>
#include <Fusion/Sketch/SketchCircles.h>
#include <Fusion/Sketch/SketchCurves.h>
using namespace adsk::core;
using namespace adsk::fusion;
Ptr<UserInterface> ui;
extern "C" XI_EXPORT bool run(const char* context)
{
Ptr<Application> app = Application::get();
if (!app)
return false;
ui = app->userInterface();
if (!ui)
return false;
Ptr<Documents> documents = app->documents();
if (!documents)
return false;
Ptr<Document> doc = documents->add(DocumentTypes::FusionDesignDocumentType);
if (!doc)
return false;
Ptr<Product> product = app->activeProduct();
if (!product)
return false;
Ptr<Design> design = product;
if (!design)
return false;
// Get the root component of the active design
Ptr<Component> rootComp = design->rootComponent();
if (!rootComp)
return false;
// Create sketch in root component
Ptr<Sketches> sketches = rootComp->sketches();
if (!sketches)
return false;
Ptr<ConstructionPlane> xz = rootComp->xZConstructionPlane();
if (!xz)
return false;
Ptr<Sketch> sketch = sketches->add(xz);
if (!sketch)
return false;
Ptr<SketchCurves> sketchCurves = sketch->sketchCurves();
if (!sketchCurves)
return false;
Ptr<SketchCircles> sketchCircles = sketchCurves->sketchCircles();
if (!sketchCircles)
return false;
Ptr<Point3D> centerPoint0 = Point3D::create(0, 0, 0);
if (!centerPoint0)
return false;
Ptr<SketchCircle> circle0 = sketchCircles->addByCenterRadius(centerPoint0, 5.0);
if (!circle0)
return false;
Ptr<Point3D> centerPoint1 = Point3D::create(10, 10, 0);
if (!centerPoint1)
return false;
Ptr<SketchCircle> circle1 = sketchCircles->addByCenterRadius(centerPoint1, 5.0);
if (!circle1)
return false;
// Get the profile defined by the circle
Ptr<Profiles> profs = sketch->profiles();
if (!profs)
return false;
Ptr<Profile> prof0 = profs->item(0);
if (!prof0)
return false;
Ptr<Profile> prof1 = profs->item(1);
if (!prof1)
return false;
// Create an extrusion input and make sure it's in a new component
Ptr<Features> feats = rootComp->features();
if (!feats)
return false;
Ptr<ExtrudeFeatures> extrudes = feats->extrudeFeatures();
if (!extrudes)
return false;
Ptr<ExtrudeFeatureInput> extInput = extrudes->createInput(prof0, FeatureOperations::NewComponentFeatureOperation);
if (!extInput)
return false;
// Set the extrusion input
Ptr<ValueInput> distance = ValueInput::createByReal(5);
if (!distance)
return false;
extInput->setDistanceExtent(true, distance);
extInput->isSolid(true);
// Create the extrusion
Ptr<ExtrudeFeature> ext = extrudes->add(extInput);
if (!ext)
return false;
// Get the side face of the created extrusion body
Ptr<BRepFaces> sideFaces = ext->sideFaces();
if (!sideFaces)
return false;
Ptr<BRepFace> sideFace = sideFaces->item(0);
if (!sideFace)
return false;
// Create the first joint geometry with the side face
Ptr<JointGeometry> geo0 = JointGeometry::createByNonPlanarFace(sideFace, JointKeyPointTypes::StartKeyPoint);
if (!geo0)
return false;
// Create the second joint geometry with prof1
Ptr<JointGeometry> geo1 = JointGeometry::createByProfile(prof1, circle1, JointKeyPointTypes::CenterKeyPoint);
if (!geo1)
return false;
// Create joint input
Ptr<Joints> joints = rootComp->joints();
if (!joints)
return false;
Ptr<JointInput> jointInput = joints->createInput(geo0, geo1);
if (!jointInput)
return false;
// Set the joint input
Ptr<ValueInput> angle = ValueInput::createByString("90 deg");
if (!angle)
return false;
jointInput->angle(angle);
Ptr<ValueInput> offset = ValueInput::createByString("1 cm");
if (!offset)
return false;
jointInput->offset(offset);
jointInput->isFlipped(true);
jointInput->setAsRevoluteJointMotion(JointDirections::YAxisJointDirection);
// Create the joint
Ptr<Joint> joint = joints->add(jointInput);
if (!joint)
return false;
Ptr<RevoluteJointMotion> revoluteMotion = joint->jointMotion();
if (!revoluteMotion)
return false;
Ptr<JointLimits> limits = revoluteMotion->rotationLimits();
if (!limits)
return false;
limits->isMinimumValueEnabled(true);
limits->minimumValue(3.14 / 3);
limits->isMaximumValueEnabled(true);
limits->maximumValue(3.14 / 3 * 2);
return true;
}
/** * RevoluteJointMotion API Sample * Demonstrates creating a joint with revolute joint motion. */ import { adsk } from '@adsk/fusion'; function run() { // Get the Fusion API's application object const app = adsk.core.Application.get(); if (!app) throw Error("No adsk.core.Application."); // Create a document. const doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType) const design = app.activeProduct as adsk.fusion.Design; // Get the root component of the active design. const rootComp = design.rootComponent // Create sketch in root component const sketches = rootComp.sketches const sketch = sketches.add(rootComp.xZConstructionPlane) const sketchCircles = sketch.sketchCurves.sketchCircles const centerPoint0 = adsk.core.Point3D.create(0, 0, 0) const circle0 = sketchCircles.addByCenterRadius(centerPoint0, 5.0) const centerPoint1 = adsk.core.Point3D.create(10, 10, 0) const circle1 = sketchCircles.addByCenterRadius(centerPoint1, 5.0) // Get the profile defined by the circle const prof0 = sketch.profiles.item(0) const prof1 = sketch.profiles.item(1) // Create an extrusion input and make sure it's in a new component const extrudes = rootComp.features.extrudeFeatures const extInput = extrudes.createInput(prof0, adsk.fusion.FeatureOperations.NewComponentFeatureOperation) // Set the extrusion input const distance = adsk.core.ValueInput.createByReal(5) extInput.setSymmetricExtent(distance, false) extInput.isSolid = true // Create the extrusion const ext = extrudes.add(extInput) // Get the side face of the created extrusion body const sideFace = ext.sideFaces.item(0) // Get the occurrence of the new component const occ = rootComp.occurrences.item(0) // Create the first joint geometry with the side face const geo0 = adsk.fusion.JointGeometry.createByNonPlanarFace(sideFace, adsk.fusion.JointKeyPointTypes.StartKeyPoint) // Create the second joint geometry with prof1 const geo1 = adsk.fusion.JointGeometry.createByProfile(prof1, circle1, adsk.fusion.JointKeyPointTypes.CenterKeyPoint) // Create joint input const joints = rootComp.joints const jointInput = joints.createInput(geo0, geo1) // Set the joint input const angle = adsk.core.ValueInput.createByString('90 deg') jointInput.angle = angle const offset = adsk.core.ValueInput.createByString('1 cm') jointInput.offset = offset jointInput.isFlipped = true jointInput.setAsRevoluteJointMotion(adsk.fusion.JointDirections.YAxisJointDirection) // Create the joint const joint = joints.add(jointInput) const revoluteMotion = joint.jointMotion as adsk.fusion.RevoluteJointMotion const limits = revoluteMotion.rotationLimits limits.isMinimumValueEnabled = true limits.minimumValue = 3.14 / 3 limits.isMaximumValueEnabled = true limits.maximumValue = 3.14 / 3 * 2 // Unground component from parent occ.isGroundToParent = false } run();