import adsk.core, adsk.fusion, traceback
def run(context):
ui = None
try:
app = adsk.core.Application.get()
ui = app.userInterface
# Create a document.
doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType)
product = app.activeProduct
design = adsk.fusion.Design.cast(product)
# Get the root component of the active design
rootComp = design.rootComponent
# Create a sketch
sketches = rootComp.sketches
sketch1 = sketches.add(rootComp.yZConstructionPlane)
# Create an object collection for the points.
points = adsk.core.ObjectCollection.create()
# Define the points the spline with fit through.
points.add(adsk.core.Point3D.create(-5, 0, 0))
points.add(adsk.core.Point3D.create(5, 1, 0))
points.add(adsk.core.Point3D.create(6, 4, 3))
points.add(adsk.core.Point3D.create(7, 6, 6))
points.add(adsk.core.Point3D.create(2, 3, 0))
points.add(adsk.core.Point3D.create(0, 1, 0))
# Create the spline.
spline = sketch1.sketchCurves.sketchFittedSplines.add(points)
# Get sketch lines
sketchLines = sketch1.sketchCurves.sketchLines
# Create sketch rectangle
startPoint = adsk.core.Point3D.create(0, 0, 0)
endPoint = adsk.core.Point3D.create(5.0, 5.0, 0)
sketchLines.addTwoPointRectangle(startPoint, endPoint)
# Get two sketch lines
sketchLineOne = sketchLines.item(0)
sketchLineTwo = sketchLines.item(1)
# Get the profile
prof = sketch1.profiles.item(0)
# Create an extrusion input
extrudes = rootComp.features.extrudeFeatures
extInput = extrudes.createInput(prof, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)
# Define that the extent is a distance extent of 5 cm
distance = adsk.core.ValueInput.createByReal(5.0)
# Set the distance extent
extInput.setDistanceExtent(False, distance)
# Set the extrude type to be solid
extInput.isSolid = True
# Create the extrusion
ext = extrudes.add(extInput)
# Get the body with the extrude
body = ext.bodies.item(0)
# Get a vertex of the body
vertex = body.vertices.item(5)
# Get a face of the vertex
face = vertex.faces.item(0)
# Create perpendicular construction axis
axes = rootComp.constructionAxes
axisInput = axes.createInput()
axisInput.setByPerpendicularAtPoint(face, vertex)
axis = axes.add(axisInput)
# Create construction point
points = rootComp.constructionPoints
pointInput = points.createInput()
pointInput.setByTwoEdges(sketchLineOne, sketchLineTwo)
point = points.add(pointInput)
# Create construction plane
planes = rootComp.constructionPlanes
planeInput = planes.createInput()
offsetValue = adsk.core.ValueInput.createByReal(3.0)
planeInput.setByOffset(prof, offsetValue)
plane = planes.add(planeInput)
# Create another sketch
sketch2 = sketches.add(rootComp.xZConstructionPlane)
entities = []
entities.append(body) # body
entities.append(face) # face
entities.append(sketchLineOne) # edge
entities.append(vertex) # vertex
entities.append(spline) # sketch curve
entities.append(axis) # construction axis
entities.append(point) # construction point
entities.append(plane) # construction plane
sketchEntities = sketch2.intersectWithSketchPlane(entities)
except:
if ui:
ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))
#include <Core/Application/Application.h>
#include <Core/Application/Document.h>
#include <Core/Application/Documents.h>
#include <Core/Geometry/Point3D.h>
#include <Core/UserInterface/UserInterface.h>
#include <Core/Application/ObjectCollection.h>
#include <Fusion/Components/Component.h>
#include <Fusion/Construction/ConstructionPlanes.h>
#include <Fusion/Construction/ConstructionPlane.h>
#include <Fusion/Construction/ConstructionPlaneInput.h>
#include <Fusion/Construction/ConstructionAxes.h>
#include <Fusion/Construction/ConstructionAxis.h>
#include <Fusion/Construction/ConstructionAxisInput.h>
#include <Fusion/Construction/ConstructionPoints.h>
#include <Fusion/Construction/ConstructionPointInput.h>
#include <Fusion/Construction/ConstructionPoint.h>
#include <Fusion/Fusion/Design.h>
#include <Fusion/Sketch/Sketch.h>
#include <Fusion/Sketch/Sketches.h>
#include <Fusion/Sketch/SketchCurves.h>
#include <Fusion/Sketch/SketchLines.h>
#include <Fusion/Sketch/SketchLine.h>
#include <Fusion/Sketch/SketchFittedSplines.h>
#include <Fusion/Sketch/SketchFittedSpline.h>
#include <Fusion/Sketch/Profiles.h>
#include <Fusion/Sketch/Profile.h>
#include <Fusion/Features/Features.h>
#include <Fusion/Features/ExtrudeFeatures.h>
#include <Fusion/Features/ExtrudeFeatureInput.h>
#include <Fusion/Features/ExtrudeFeature.h>
#include <Fusion/BRep/BRepBodies.h>
#include <Fusion/BRep/BRepBody.h>
#include <Fusion/BRep/BRepFaces.h>
#include <Fusion/BRep/BRepFace.h>
#include <Fusion/BRep/BRepVertices.h>
#include <Fusion/BRep/BRepVertex.h>
using namespace adsk::core;
using namespace adsk::fusion;
Ptr<UserInterface> ui;
extern "C" XI_EXPORT bool run(const char* context)
{
Ptr<Application> app = Application::get();
if (!app)
return false;
ui = app->userInterface();
if (!ui)
return false;
Ptr<Documents> docs = app->documents();
if (!docs)
return false;
// Create a document.
Ptr<Document> doc = docs->add(DocumentTypes::FusionDesignDocumentType);
if (!doc)
return false;
Ptr<Design> design = app->activeProduct();
if (!design)
return false;
// Get the root component of the active design
Ptr<Component> rootComp = design->rootComponent();
if (!rootComp)
return false;
// Create a new sketch on the yz plane.
Ptr<Sketches> sketches = rootComp->sketches();
if (!sketches)
return false;
Ptr<ConstructionPlane> yzPlane = rootComp->yZConstructionPlane();
if (!yzPlane)
return false;
Ptr<Sketch> yzSketch = sketches->add(yzPlane);
if (!yzSketch)
return false;
// Create an object collection for the points.
Ptr<ObjectCollection> points = ObjectCollection::create();
if (!points)
return false;
// Define the points the spline with fit through.
points->add(Point3D::create(-5, 0, 0));
points->add(Point3D::create(5, 1, 0));
points->add(Point3D::create(6, 4, 3));
points->add(Point3D::create(7, 6, 6));
points->add(Point3D::create(2, 3, 0));
points->add(Point3D::create(0, 1, 0));
// Create the spline.
Ptr<SketchCurves> sketchCurves = yzSketch->sketchCurves();
if (!sketchCurves)
return false;
Ptr<SketchFittedSplines> splines = sketchCurves->sketchFittedSplines();
if (!splines)
return false;
Ptr<SketchFittedSpline> spline = splines->add(points);
if (!spline)
return false;
// Get sketch lines
Ptr<SketchLines> sketchLines = sketchCurves->sketchLines();
if (!sketchLines)
return false;
// Create sketch rectangle
Ptr<Point3D> startPoint = Point3D::create(0, 0, 0);
Ptr<Point3D> endPoint = Point3D::create(5.0, 5.0, 0);
sketchLines->addTwoPointRectangle(startPoint, endPoint);
// Get two sketch lines
Ptr<SketchLine> sketchLineOne = sketchLines->item(0);
Ptr<SketchLine> sketchLineTwo = sketchLines->item(1);
// Get the profile
Ptr<Profiles> profs = yzSketch->profiles();
if (!profs)
return false;
Ptr<Profile> prof = profs->item(0);
// Create an extrusion input
Ptr<Features> feats = rootComp->features();
if (!feats)
return false;
Ptr<ExtrudeFeatures> extrudes = feats->extrudeFeatures();
if (!extrudes)
return false;
Ptr<ExtrudeFeatureInput> extInput = extrudes->createInput(prof, FeatureOperations::NewBodyFeatureOperation);
// Define that the extent is a distance extent of 5 cm
Ptr<ValueInput> distance = ValueInput::createByReal(5.0);
// Set the distance extent
extInput->setDistanceExtent(false, distance);
// Set the extrude type to be solid
extInput->isSolid(true);
// Create the extrusion
Ptr<ExtrudeFeature> ext = extrudes->add(extInput);
if (!ext)
return false;
// Get the body with the extrude
Ptr<BRepBodies> bodies = ext->bodies();
if (!bodies)
return false;
Ptr<BRepBody> body = bodies->item(0);
// Get a vertex of the body
Ptr<BRepVertices> vertices = body->vertices();
if (!vertices)
return false;
Ptr<BRepVertex> vertex = vertices->item(5);
// Get a face of the vertex
Ptr<BRepFaces> vertexFaces = vertex->faces();
if (!vertexFaces)
return false;
Ptr<BRepFace> face = vertexFaces->item(0);
// Get construction axes
Ptr<ConstructionAxes> constructionAxes = rootComp->constructionAxes();
if (!constructionAxes)
return false;
// Create construction axis input
Ptr<ConstructionAxisInput> axisInput = constructionAxes->createInput();
if (!axisInput)
return false;
// Create perpendicular construction axis
axisInput->setByPerpendicularAtPoint(face, vertex);
Ptr<ConstructionAxis> axis = constructionAxes->add(axisInput);
// Get construction points
Ptr<ConstructionPoints> constructionPoints = rootComp->constructionPoints();
if (!constructionPoints)
return false;
// Create construction point input
Ptr<ConstructionPointInput> pointInput = constructionPoints->createInput();
if (!pointInput)
return false;
// Create construction point by two points
pointInput->setByTwoEdges(sketchLineOne, sketchLineTwo);
Ptr<ConstructionPoint> point = constructionPoints->add(pointInput);
// Create construction plane
Ptr<ConstructionPlanes> planes = rootComp->constructionPlanes();
if (!planes)
return false;
// Create construction plane input
Ptr<ConstructionPlaneInput> planeInput = planes->createInput();
if (!planeInput)
return false;
// Add construction plane by offset
Ptr<ValueInput> offsetValue = ValueInput::createByReal(3.0);
planeInput->setByOffset(prof, offsetValue);
Ptr<ConstructionPlane> plane = planes->add(planeInput);
// Create a new sketch on the xz plane.
Ptr<ConstructionPlane> xzPlane = rootComp->xZConstructionPlane();
if (!xzPlane)
return false;
Ptr<Sketch> xzSketch = sketches->add(xzPlane);
if (!xzSketch)
return false;
std::vector<Ptr<Base>> entities;
entities.push_back(body);
entities.push_back(face);
entities.push_back(sketchLineOne);
entities.push_back(vertex);
entities.push_back(spline);
entities.push_back(axis);
entities.push_back(point);
entities.push_back(plane);
std::vector<Ptr<SketchEntity>> resVec = xzSketch->intersectWithSketchPlane(entities);
if (resVec.empty())
return false;
return true;
}
#ifdef XI_WIN
#include <windows.h>
BOOL APIENTRY DllMain(HMODULE hmodule, DWORD reason, LPVOID reserved)
{
switch (reason)
{
case DLL_PROCESS_ATTACH:
case DLL_THREAD_ATTACH:
case DLL_THREAD_DETACH:
case DLL_PROCESS_DETACH:
break;
}
return TRUE;
}
#endif // XI_WIN