Share
 
 

Extruded Shape Propagation Types Reference

Use the Extrude or Revolve command to propagate a Match Contour or Match Shape. The side you select to keep determines the result.

Shape propagation applies to open profiles. It describes solutions that are defined through the extension of the open ends of an open profile and by the shape of the body.

Match Contour

Deselecting Match Shape results in matching the contour.

In Revolve, the open profile closes by extending the open ends of the profile until they intersect the solid body. If the sketch plane of the profile lies on a planar face, the loops of the face close the profile. Otherwise, the edges defined by the intersection of the profile plane with the body close the profile. The side you select to keep determines the result.

In Extrude, with Match Shape unselected, the profile completes using the face which it intersects, and the extrusion generated from that profile.

Extension rules for closing the profile:
  • The initial sketch plane is offset from the top surface of the base of this part.
  • The original profile lines (green) extend (red-dashed) to the face elements.
  • The loop closes by utilizing the intersection lines of the sketch plane and the solid body (purple).
  • It is required to specify the side to keep.
  • Extrude performs. The result is a normal closed loop extrusion.

Match Shape

Selecting Match Shape creates a flood-fill type solution. The open ends of the profile extend to a coedge, or face. The required faces quilt together to form a complete intersection with the extruded body. The Match Shape extrusion generates a stable and predictable body for topology changes on the defining faces. The extrude feature is not dependent upon a strictly defined profile consisting of sketch lines and referenced edges.
When you create a Match Shape extrusion, material is added to a hypothetical bucket to fill the shape. The extrusion depth corresponds to the height of the bucket. If the height gets large enough for material to overflow the bucket, you cannot create the extrusion. The side you select to keep determines the result.

For a Revolve command, a flood-fill type solution is also created. The open ends of the profile extend to the axis of revolution, if possible, or to the bounding box of the body.

Note: If you select a closed profile (not a closed region) and flood-fill everything outside the profile, the bucket analogy also applies, as shown in the following illustrations:

Parent topic: About Sketched Features

Related Tasks

Was this information helpful?