Create a Frame Part

Now that the skeleton assembly has been successfully tested, you continue building the assembly. Next, create a frame part by deriving geometry from the Skeleton-frame part.

1. Open Frame.iam.
2. Turn off the visibility of Skeleton-frame. It prevents you from accidentally selecting the surfaces in this file in later steps.
3. Click Create to create a component within the assembly.
   • Enter Frame1 in the New Component Name field.
   • Click and select Standard (mm).ipt from the Metric tab.
   • Verify that the New File Location is set to the \Tutorial Files\iCopy directory.
   • Verify that Constrain sketch plane to selected face or plane is not selected.
   • Click OK.
4. In the Model browser, expand the Origin folder under Frame.iam and select the XY Plane.
5. Exit the sketch and delete Sketch1. It is not needed for this component.
6. Click the Manage tab Insert panel Derive command.
7. In the Open dialog box, select Skeleton-frame.ipt and click Open.
8. Expand the Surface Bodies node. Set Srf1 and Srf6 to and all other surfaces to .
9. Expand the Sketches node. Set Sketch2 to and all other sketches to .
10. Expand the Work Geometry node. Set Work Plane5 to and all other work planes to .
11. In the Derive dialog box, click OK. The surfaces and sketch from Skeleton-frame are added to the part. Using the Derive command to add these surfaces maintains a link between the two files. The visibility of Skeleton-frame.ipt is turned off for clarity in the following image.
    
12. Start the Extrude command.
    • Sketch2 is selected automatically. It is the only closed profile in the part.
    • In the Extents drop-down menu, select Between.
    • Select Srf1 and Srf6 as the Between planes. The order does not matter.
    • Click OK.
    
13. Turn off the visibility of the surfaces from the derived part (Srf1 and Srf6). It prevents you from accidentally selecting them in later steps.
14. Return to the main assembly (Frame.iam).

Previous | Next