Work point reference

Access

• In a 3D sketch, click ModelWork Features and then click Point or Grounded Point.
• In a part file, click ModelWork Features and then click Point or Grounded Point. Alternatively, select an explicit work point creation method from the Point drop-down menu.
• In an assembly file, click 3D Model tab Work Feature panel Point.

In a part, an ungrounded work point can be created in-line while using another work feature command. The Point command terminates as soon as the work point is created.

Tip: To understand geometric dependencies, right-click a work feature in the browser or the graphics window, and then select Show Inputs. For example, you can right-click a work point to highlight the geometry from which it was created, such as a work axis and a work plane.

The Point drop-down menu offers the following work point creation options:

Point (legacy method)

Select the appropriate model vertices, edge and axis intersections, or intersections of three nonparallel faces or planes to create a work point.

Grounded Point

Click a work point, midpoint, or vertex. A pushpin cursor symbol indicates the selection is grounded.

On Vertex, Sketch point, or Midpoint

Select a 2D or 3D sketch point, vertex, or the endpoint or midpoint of a line or linear edge.

Intersection of Three Planes

Select three work planes or planar faces.

Intersection of Two Lines

Select any combination of two lines including linear edges, 2D or 3D sketch lines, and work axes.

Intersection of Plane/Surface and Line

Select a planar face or work plane and a work axis or line. Alternatively, select a surface and a sketch line, straight edge, or work axis.

Center Point of Loop of Edges

First, right-click and select Loop Select from the pop-up context menu. Then select one edge of a closed loop of edges.

Center Point of Torus

Select a torus.

Center Point of Sphere

Select a sphere.