Sheet metal cut reference

Removes material from a sheet metal face. The shape of the cut feature is controlled by the sketched profile.

Access:

Ribbon: Sheet Metal tab Modify panel Cut

Shape
	Profile Selects a profile to remove material. If there are multiple profiles and none are selected, click Profile, and then click one or more profiles. The material to remove is previewed in the graphics window.
	Single profile Automatically selects profile and previews the cut.
	Multiple profiles Position the cursor over the profile and click to select. To cancel the selection, press Ctrl and click the profile.
Cut Across Bend - Check to remove material by wrapping the profile across faces and one or more sheet metal bends. If there are multiple profiles and none are selected, click Profile and then click one or more profiles. The material to remove is previewed in the graphics window.

Extents
Extent Type drop-down select field - Allows the selection of the type of extent:
	Distance Default method. Establishes the depth and direction of the cut. The cut is perpendicular to the sketch plane.
	To Next Cut terminates on the next plane or face. Selects the direction for the cut.
	To Selects an ending face or plane on which to terminate the cut. You can terminate the cut on the selected face, or on a face that extends beyond the termination plane. In an assembly, the face or plane can be on another part.
	From - To Selects beginning and ending faces or planes on which to terminate the extrusion. In an assembly, the faces or planes can be on other parts.
	All Extrudes the profile through all features and sketches in the specified direction. Select the direction of the cut or extrude the cut equally in both directions.
Thickness value field - Allows the thickness of the cut to be specified:
	Thickness - Default cut depth is equal to the Thickness parameter of the sheet metal material and results in a through cut. When the Cut Across Bend option is selected the cut is applied to the faces and bends located under the sketch while the part is in a flattened state. The cut depth is through the material.
	Thickness/"n" - A partial depth cut can be specified by using the Thickness parameter in an equation. May be specified as an absolute depth value. Thickness/2 results in a cut that was half the depth of the material thickness. When the Cut Across Bend option is selected the cut is applied to the faces and bends located under the sketch while the part is in a flattened state. The cut depth is equal to the value specified by the equation.
Measure - Uses the distance defined by two points or an edge for the thickness of the cut.
Show Dimensions - Displays the dimensions for a selected feature. Uses the distance determined by a selected dimension as the thickness for the cut.
List Parameters - Displays a list of defined parameters in the file which can be selected as the thickness for the cut.

Offset
	Flips the direction of the cut from the default setting. Useful when the cut sketch is created on a reference plane. Results in no material removal when the sketch is created on a sheet metal face.
	The default direction selected. Removes material from the plane of the selected sketch towards the material thickness of the part.
	Defines the cut sketch as being the mid-plane of the cut thickness. Can be useful when the cut sketch is created on an appropriately positioned reference plane.

OK	Click OK to create (or modify) a bend using the parameters and options specified and close the dialog box.

Cancel

Click Cancel to discard any edits made to parameters or options and close the dialog box.