Modeling modes in Fusion
In Fusion, you can choose between two modeling modes, based on your design needs at any given time during the design process.
- Parametric Modeling mode: Captures design history and parametric relationships in a timeline.
- Direct Modeling mode: Does not capture any design history or parametric relationships.
Parametric Modeling mode
When a design is in Parametric Modeling mode, Fusion tracks each feature in a parametric Timeline as you evolve the design.
You can build your design intent through a robust set of parametrically linked features like:
- Sketches
- Construction geometry
- 3D modeling operations for solid, surface, and mesh bodies
- Assembly relationships
- Named parameters
- Standard and sheet metal components
Each parametric feature adds parameters for its settings to the design. You can reference these parameters associatively in other parametric features.
You can use the Modify > Change Parameters command to edit all the parameters in the design. When you change the value of a parameter, the Timeline recomputes and any features that reference the parameter will update to reflect the change.
Direct Modeling mode
When a design is in Direct Modeling mode, Fusion does not track features parametrically.
You can quickly explore form and function in this mode, before committing to specific parametric relationships or assembly structure. However, you cannot later convert geometry that you create in Direct Modeling mode to separate parametric features and relationships.
Recognizable features are tracked in the Browser, where you can do the following:
| Action | Example |
|---|---|
| Edit |  |
| Dissolve |  |
| Delete |  |
Base Features
In Parametric Modeling mode, a Base Feature is a a feature in the parametric Timeline where you can create and edit geometry in Direct Modeling mode without switching the entire design to Direct Modeling mode and dissolving the design history.
- A Base Feature is automatically created as the first feature in the Timeline when you switch from Direct Modeling mode to Parametric Modeling mode.
- You can use the Solid > Create > Create Base Feature command to create additional Base Features as needed.
- This works well when you need to bring standard components or reference components into an assembly, to design around them or redesign them in Fusion. They may not require full parametric intelligence, but you can still edit their Base Features directly to make minor adjustments to the starting shape.
- When you edit a Base Feature, you enter the Base Feature contextual environment, which is a Direct Modeling session within the parametric design.
Switching modes
You can right-click the Default Component in the Browser to switch the design from one modeling mode to the other.
Use the Do Not Capture Design History command to switch from Parametric Modeling mode to Direct Modeling mode:
- The Timeline and any features that were created in Parametric Modeling mode are removed from the design.
- Recognizable features like Extrude, Fillet, and Hole are added to the Browser.
- All new features you create are not tracked parametrically.
Use the Capture Design History command to switch from Direct Modeling mode to Parametric Modeling mode:
- The Timeline is added to the design.
- The geometry you created in Direct Modeling mode is captured as a single Base Feature in the Timeline.
- You can edit the Base Feature, which acts as a contained Direct Modeling environment within the parametric design.
- Changes you make to the Base Feature are not tracked parametrically.
- As you create and modify geometry in Parametric Modeling mode, new features are added to the Timeline as design history.