Create a base view placeholder

Learn how to create a base view placeholder in a drawing template in the Drawing workspace in Fusion.

1. Create or open a drawing template.

2. In the Template contextual environment, on the toolbar click Create > Base View Placeholder .

   The Placeholder View dialog displays and a preview of the base view placeholder displays at the cursor.

3. Click to place the base view placeholder on the sheet.

4. In the Placeholder View dialog, select the Reference.

   • Create New: Adds a new reference to the browser.
   • Existing Reference: Adds the base view to the selected existing reference in the browser.

5. Select the Representation.

   • Assembly
   • Component
   • Folded Component
   • Flat Pattern
   • Storyboard

6. Adjust the Appearance settings:

   • Orientation: Select one of the standard orthographic views or a named view.
   • Style: Select a display style.
     • Visible Edges
     • Visible and Hidden Edges
     • Shaded
     • Shaded with Hidden Edges
   • Scale: Select a scale.

7. Adjust the Edge Visibility settings:

   • Tangent Edges: Select a display style for tangent edges.
     • Full Length
     • Shortened
     • Off
   • Interference Edges: Check to display interference edges.
   • Thread Edges: Check to display threaded edges.

8. Specify the automatic creation of Center Marks and Center Lines:

   • Centermarks: Choose the hole types that receive automated center marks.
     • Hole: Creates a center mark for hole features.
     • Round Extrudes: Creates a center mark for round extrudes.
     • Round Cuts: Creates a center mark for round cuts.
     • Fillet: Creates a center mark for fillets.
     • Minimum fillet radius: Specify the minimum fillet radius for a center mark to be created.
     • Maximum fillet radius: Specify the maximum fillet radius for a center mark to be created.
   • Center Lines: Choose the hole types that receive automated center lines.
     • Hole: Creates a center line for hole features.
     • Round Extrudes: Creates a center line for round extrudes.
     • Round Cuts: Creates a center line for round cuts.

9. Select OK.

The base view placeholder displays on the sheet.

The settings will be applied to the base view in new drawings you create using this template.