Drawing View reference

In the Drawing View dialog, you can edit the properties of a drawing view in the Drawing workspace in Fusion.

Templates

If you plan to reuse title blocks, borders, document settings, or sheet settings across multiple drawings, create a drawing template to save time and apply consistent standards. You can also create placeholder views and placeholder tables that automatically generate drawing views and part lists from the referenced design when you use the template to create a new drawing.

Access the Drawing View dialog

Double-click a base view, projected view, section view, detail view, or perspective view.

Reference (base view and perspective view only)

Specify whether to create a new reference or associate the new base view with an existing reference.

Create New: Adds a new reference node to the browser.
Existing Reference: Associates the new base view to the selected existing reference node in the browser.

Note: You can only define the reference when you first create a base view. You cannot modify this setting for an existing view.

Representation (base view only and perspective view only)

Specify whether the base view will represent the static design assembly or an animation from a storyboard.

Model: Creates a base view that represents the static design assembly.
Storyboard: Creates a base view that represents an animation.

Note: You can only define the representation when you first create a base view. You cannot modify this setting for an existing view.

Appearance

Adjust the Orientation, Style, Scale, and Name settings.

Orientation (base view and perspective view only)

Select one of the standard orthographic views or a named view.

Named View: Any named view defined in the design.
Top
Bottom
Left
Right
Front
Back
SW Isometric
SE Isometric
NE Isometric
NW Isometric

Note: You can only define the orientation when you first create a base view. You cannot modify this setting for an existing view.

Style

Select the view style for the selected drawing view.

From Parent: Inherits the view style from the parent view. (Projected view, section view, and detail view only.)
Visible Edges
Visible Edges and Hidden Edges
Shaded
Shaded with Hidden Edges

Improve View Quality (Shaded and Shaded with Hidden Edges)

Select the Improve View Quality checkbox to improve the appearance of shaded views of designs with a mix of long thin and thick parts. When selected, the file size increases which may adversely affect performance.

Scale

Select the view scale from the dropdown menu or type a custom scale.

Scale Formats	Examples
Ratio	1:48 and 1/4"=1'
Fraction	1/48 and 3/5
Decimal	.125 and 0.25

Name (section view and detail view only)

Specify the identifier for the section view or detail view.

Focal Length (perspective view only)

Choose the focal length to apply to the perspective view.

Narrow: Provides a narrow field of view.
Wide: Provides a wide field of view.

Edge Visibility

Adjust the Tangent Edges, Interference Edges, and Thread Edges settings.

Tangent Edges

Select a display style for tangent edges.

Full Length
Shortened
Off

Interference Edges

Check to display edges where components intersect.

Thread Edges

Check to display threads on threaded edges.

Automated Center Marks and Center Lines

Automatically create center lines and center marks for all holes in a view.

Center Marks

Choose the hole types that receive automated center marks.

Hole: Creates a center mark for hole features.
Round Extrudes: Creates a center mark for round extrudes.
Round Cuts: Creates a center mark for round cuts.
Fillet: Creates a center mark for fillets.

Minimum fillet radius (Fillet only)

Specify the minimum fillet radius for a center mark to be created.

Maximum fillet radius (Fillet only)

Specify the maximum fillet radius for a center mark to be created.

Center Lines

Choose the hole types that receive automated center lines.

Hole: Creates a center line for hole features.
Round Extrudes: Creates a center line for round extrudes.
Round Cuts: Creates a center line for round cuts.

Section Depth (section view only)

Adjust the Depth, Distance, and Set Distance settings.

Depth

Select a depth option for the section view.

Full: Displays all geometry cut through and shown beyond the section line.
Slice: Only displays geometry cut through by the section line.
Distance: Only displays geometry between the section line and a specified distance beyond it.

The in-canvas slider's movement is limited to the area between the section line and the edge of the parent view. As the in-canvas slider moves, the preview updates accordingly. Once a point is specified within the canvas or a value is entered directly into the Distance property, the in-canvas slider detaches from the cursor and remains at the specified point\distance.

Distance (Distance only)

Specify the distance from the section line to display geometry.

Set Distance (Distance only)

Click to reset Distance.

Objects to Cut (section view only)

Uncheck components to exclude them from being cut through in a section view.

When a component is unchecked, it still displays as an uncut component in the section view.