Activity 2: Create and apply a new rule

The sheet metal component uses the default rule, which specifies certain shapes and thicknesses. In this activity you

• Create a new rule, to change the shape and thickness of the flange

• Apply the new rule to the body.

  

Prerequisites

• Activity 1 is completed.

Steps

1. Create a new Sheet metal rule starting from Steel (mm) in Default rules, and set the Thickness to 1.5 mm. Define the bend and corner relief attributes as follows:

   • Change the Bend radius to Thickness * 1.15
   • Change the 2-Bend corner relief shape to Square
   • Change the relief Size to Thickness * 3.0.

   1. In the Design workspace, on the Sheet Metal tab, select Modify > Sheet Metal Rules Library .

   2. Select Default rules , right-click Steel (mm), and select Copy.

      Fusion adds the copy to Shared rules.

   3. Select Shared rules, right-click the copied rule, and select Edit.

   4. Type a name for the new rule, then set Thickness to 1.5 mm.

   5. Set Bend radius to Thickness * 1.15.

   6. Under 2-Bend corner relief, set Shape to Square and Size to Thickness * 3.0.

   7. Click Continue, review your changes, then click Save.

   8. Click Close to close the Sheet Metal Rules Library.

2. Apply the new rule to your design.

   1. In the Browser, expand Component 1:1 .

      Notice that there is a Rule node indicating the name of the rule used for the sheet metal body.

   2. Place the pointer over Rule: Steel (mm) in the Browser.

      Note: A Switch rule control appears on the right side of the row only while you hover over it. It uses the same icon as the Rule node on the left, so it can be easy to overlook until the row is highlighted.

   3. Click Switch rule .

      The Switch sheet metal rule dialog opens.

   4. In the Switch sheet metal rule dialog, click the Rule drop-down list.

   5. Select your new rule if it appears under rules recently used in this design. If it is not listed, select Select from library....

      The Sheet Metal Rules Library opens.

   6. In the library, select Shared rules , then select your new rule.

   7. Click OK.

      The new rule is changed in the browser, and the body is updated accordingly.

Activity 2 summary

In this activity you

• Created a new sheet metal rule, to change the shape and thickness of the flange
• Applied the new rule to the sheet metal body.