Split the Part into Two Solid Bodies

The interior of the part is now hollow. In the next section of the exercise, we use a top-down workflow to split the part into multiple solid bodies.

1. On the Surface panel, select the Thicken/Offset command.
2. In the graphics window, select the top of the part to satisfy the selection.
3. In the dialog box, select Surface for the Output. Enter a distance value of 3-mm. Use the flip direction arrow to offset the surface towards the interior of the part.
   
4. Select OK to create the offset surface and finish the command.
5. Highlight the new surface in the browser to view.
   
6. On the Surface panel, click the drop-down arrow to expose all available commands.
7. Select the Extend command in the drop-down.
   
8. Select the two outside edges of the offset surface to satisfy the Edges selection. Specify an offset value of 7.5 mm. Click OK to finish the command.
   
9. On the Modify panel, click the Split command.
10. In the dialog box, select the Split Solid option.
11. Select the offset surface as the Split Tool.
    
12. Click OK to split the part into two solid bodies and finish the command.
13. In the browser, turn off the visibility of the offset surface. Because the extended edges are dependent on the offset surface, the originating surface controls the feature visibility.
14. Expand the Solid Bodies folder in the browser. There are now two solid bodies present in the file. You can control the visibility and color of each body individually.
    
15. Save the file.

Previous | Next