Cut dialog box

Defines the material in a cut feature to remove from a sheet metal face.

The sketched profile controls the shape of a cut feature in sheet metal.

Shape

Profile: Selects a profile to remove material. If there are multiple profiles and none are selected, click Profile, and then click one or more profiles. In the graphics window, the material to remove highlights.
Single profile: Automatically selects profile, and previews the cut.
Multiple profiles: Position the cursor over the profile and click to select. To cancel the selection, hold down CTRL, and click the profile.
Cut Across Bend: Removes material by wrapping the profile across faces and one or more sheet metal bends. If there are multiple profiles and none are selected, click Profile and then click one or more profiles. In the graphics window, the material to remove highlights. Not available if you select Cut Normal.
Cut Normal: Projects the selected profiles (sketch, and so on) onto the surface and then cuts perpendicular to the facesthat the projection intersects. Not available if you select Cut Across Bend.

Extents

Extent Type

Distance: Default method. Establishes the depth and direction of the cut. The cut is perpendicular to the sketch plane.
To Next: Specifies that the cut terminates on the next plane or face. Selects the direction for the cut.
To: Specifies an ending face or plane to terminate the cut. You can terminate the cut on the selected face, or on a face that extends beyond the termination plane. In an assembly, the face or plane can be on another part.
From - To: Selects beginning and ending faces or planes on which to terminate the extrusion. In an assembly, the faces or planes can be on other parts.
All: Extrudes the profile through all features and sketches in the specified direction. Select the direction of the cut or extrude the cut equally in both directions.

Thickness

Thickness: Default cut depth is equal to the Thickness parameter of the sheet metal material, and results in a through cut. Cut Across Bend applies the cut to the faces and bends located under the sketch while the part is in a flattened state. The cut depth is through the material.
Thickness/"n": You can use a partial depth cut by using the Thickness parameter in an equation. Can specify as an absolute depth value. Thickness/2 results in a cut that is half the depth of the material thickness. Cut Across Bend applies the cut to the faces and bends located under the sketch while the part is in a flattened state. The cut depth is equal to the value specified by the equation.

Measure

Uses the distance defined by two points or an edge for the thickness of the cut.

Show Dimensions

Displays the dimensions for a selected feature. Uses the distance determined by a selected dimension as the thickness for the cut.

List Parameters

Displays a list of the defined parameters in the file. You can select one as the thickness for the cut.

Offset

: Flips the direction of the cut from the default setting. Useful when the cut sketch is created on a reference plane. When the sketch is created on a sheet metal face, results in no material removal.
: Removes material from the plane of the selected sketch towards the material thickness of the part. Default direction.
: Defines the cut sketch as the midplane of the cut thickness. Useful when the cut sketch is created on an appropriately positioned reference plane.