To Machine a Groove

Next we need to machine the central groove and to clean the corners/angles. This is because the previous operation left material in these areas due to the corner radius of the insert used. It is possible to do both tasks in a single operation using the Groove strategy to remove the excess material.

1. On the ribbon, click CAM tab Turning panel Groove .

Tool tab

1. On the Tool tab, click to open the Tool Library.
2. Click the button to add a new tool.
3. On the Insert tab, select Grooving from the Type: drop-down menu. Then, select Square from the Shape: drop-down menu to specify the tool tip and enter the following values:
   • Corner radius: 0.25 mm
   • Groove width: 2.5 mm
   • Width: 2.2 mm

   Leave the rest of the values at their defaults.

4. On the Holder tab, select External Grooving from the Style: drop-down menu.
5. Change Head length to: 50 mm
6. On the Setup tab, select Insert Center from the Compensation: drop-down menu.
7. Click the button to select the tool for your operation and close the tool dialog. This same tool will be used for a later parting operation.
8. Click to close the Tool Library dialog.

Geometry tab

Now remove the material the previous operation did not remove.

1. Click the Geometry tab.
2. Enable the Rest Machining group.

Passes tab

The parameters in the Passes group control how the grooving toolpath is calculated.

1. Click the Passes tab.
2. Enable the Finishing passes check box.
3. Enable the Roughing Passes group.

Start the Calculation

1. Click at the bottom of the Operation dialog box, or right-click in the graphics window and select OK from the marking menu, to automatically start calculating the toolpath.

The toolpath is now calculated and a preview appears in the graphics window.

Continue to To Cut an External Thread...