|
Reserved word |
Definition |
|---|---|
|
<AIR-BLAST> |
Returns the Air Blast codes from the CNC-Info > NC Codes dialog according to selections from the Misc. feature creation page. |
|
<BOL> |
Beginning of line identifier. Used to indent line in NC code output. Indents line by spacing amount between <BOL> and rest of line. |
|
<CANCEL-COOL> |
Used to output NC code to turn off coolant at the end of an operation. See the CNC-Info > Coolant dialog. |
|
<COMP-STAT> |
Returns the applicable code from the CNC-Info > NC Codes dialog, when tool nose radius compensation is selected in the Turn Properties dialog (for example G41, G42). Turns On at the first feed move of the profile path. |
|
<COOLANT> |
Returns the Coolant ON code for the selected turret from the Coolant dialog. |
|
<COOLANT-3> |
Returns string from the XBUILD Coolant dialog. |
|
<COOLANT-4> |
Returns string from the XBUILD Coolant dialog. |
|
<COOLANT-MST> |
Returns string from the XBUILD Coolant dialog. |
|
<COOLANT-OFF> |
Returns string from the XBUILD Coolant dialog. |
|
<COOLANT-ON> |
Returns string from the XBUILD Coolant dialog. |
|
<CTRL-TURRET> |
Indicates which turret has control while the sub-spindle is moving. The values are Main Upper, Main Lower, Sub Upper, or Sub Lower. |
|
<CUTOFF-TRT> |
This indicates which turret has the cutoff operation. The values are empty (no cutoff), Main Upper, Main Lower, Sub Upper, Sub Lower. |
|
<CYCLE> |
Returns the appropriate drill cycle code from the CNC-Info > NC Codes dialog. |
|
<DATE> |
Returns the date that the NC code was posted. See also <REGION-DATE>. |
|
<EOB> |
Specifies the end of block code on each line of a format. |
|
<FM-NAME> |
Returns the FeatureCAM file name. |
|
<F-UNITS> |
Returns the applicable code for feed per revolution or feed per linear unit feed rates from the CNC-Info > Feeds & Speeds dialog. For example, G99, G98. |
|
<FIXTURE> |
Returns the current fixture offset code from the CNC-Info > Fixture ID dialog. |
|
<GRAB-TYPE> |
Returns the Spindle Action value from a Part Handling feature in FeatureCAM. |
|
<MACH-TIME> |
Returns the estimated time needed to machine the part. |
|
<MATERIAL> |
Outputs the name of the material. |
|
<MCSID> |
Returns the current Setup name, as set in FeatureCAM. |
|
<MOTION> |
Returns the motion code for the current move from the XBUILD CNC-Info > NC codes dialog. |
|
<NEXT-TL-NAME> |
For Siemens controls, returns the name of the next tool. See also <NEXT-TL-ID> (numeric). |
|
<OP-PASS> |
Returns Rough or Finish based on the type of pass. Value is always in English in order to support language-independent comparison. See also <OP-PASS-LOCAL>. |
|
<OP-PASS-LOCAL> |
Same as <OP-PASS>, but the value is in the local language, so it can be used for inserting comments in the NC code. |
|
<OP-TYPE> |
Returns the current operation type name. Value is always in English in order to support language-independent comparison. See also <OP-TYPE-LOCAL>. |
|
<OP-TYPE-LOCAL> |
Same as <OP-TYPE>, but the value is in the local language, so it can be used for inserting comments in the NC code. |
|
<P1> |
Post variable number one. Returns the user-defined string placed in the Post Variables tab in FeatureCAM. Variables up to <P100> may be defined. |
|
<PGM-STOP> |
Returns string from CNC-Info > NC Codes dialog. Used to stop program to flip part in chuck or vise to machine other setups. |
|
<PRO-COMP> |
When tool tip compensation and canned cycle status is selected, <PRO-COMP> returns the applicable code from the CNC-Info > NC Codes dialog to establish a right/left tool relationship with the part, and turns On at the first feed move of the profile path. |
|
<PRO-FUNITS> |
Used within a Turning Canned Cycle format to return applicable code for feed per revolution or feed per linear unit, for example G99, G98. |
|
<PROG-NAME> |
Returns the part name from the Setup definition in FeatureCAM. |
|
<PVAR:variablename> |
Post variable with the name variablename. Returns the user-defined string placed in the Post Variables tab in FeatureCAM. You can edit the variable names using the Post Variable Names dialog. |
|
<REGION-DATE> |
Returns the date in the regional format (for example, British DD/MM/YY instead of MM/DD/YY) as specified in Windows. |
|
<SEG-CMT> |
Returns any Comments entered in a feature's Post Variables dialog in FeatureCAM. For controls that require comments to be a single line, <SEG-CMT> must be only one line. |
|
<SEGM-ID> |
Returns the name of the current feature from the part view in FeatureCAM. |
|
<SPINDLE> |
Returns the applicable code for spindle rotation direction from the CNC-Info > NC Codes dialog, for example M3, M4. |
|
<SPNDLE-SEL> |
Returns the applicable code to select main or sub spindle from the CNC-Info > Spindles dialog. |
|
<SPDL-SYNCRN> |
Spindle synchronization status. Valid in the spindle synchronize format. Returns the synchronize code from the XBUILD Spindles dialog. |
|
<SP-RANGE> |
Returns code to engage applicable speed range from the CNC-Info > Feeds & Speeds dialog. |
|
<SUPPRT-TYPE> |
For use with the Support On and Support Off part handling features. Indicates the type of support being used. Values are SubSpindle, Tailstock, or SteadyRest type. |
|
<TIME> |
Returns the time when the NC code was posted. |
|
<TOOL-CMT> |
Returns any Comments you have entered on the Overrides tab of Tool Properties. |
|
<TOOL-ID> |
Returns the Tool ID value from the FeatureCAM Tool Mapping dialog. |
|
<TOOL-NAME> |
Returns the Name of the current tool from the FeatureCAM Tool Mapping dialog. |
|
<TOOL-ORIENT> |
Returns the tool orientation prefix from the <TOOL-NAME> for turning tools only, for example SW, NE. |
|
<TP#-ADDRESSING> |
Returns information on what each tool post is doing at the current sync point. Possible values are idle, unknown, main, sub, both, or progend. # can be 1-4. |
|
<TP#-ADDRESSING-NEXT> |
Returns information on what each tool post is doing at the next sync point. Possible values are idle, unknown, main, sub, both, or progend. # can be 1-4. |
|
<TRT-TURN> |
Returns the applicable code for a CW or CCW turret rotation from the CNC-Info > Turrets dialog. Corresponds to the Turret Direction parameter from the Feature Properties > Tool Usage dialog. |
|
<TURRET> |
Selects the programmed turret. Corresponds to the Turret parameter from the Feature Properties > Tool Usage dialog. |
|
<TURRET1-LOC> |
This indicates the Location of turret 1 while the sub-spindle is moving, taken from the Transfer Turret Control dialog in FeatureCAM. The values are None, Home, Escape, or Cutoff Location. |
|
<TURRET2-LOC> |
This indicates the Location of turret 2 while the sub-spindle is moving, taken from the Transfer Turret Control dialog in FeatureCAM. The values are None, Home, Escape, or Cutoff Location. |
|
<TURRET3-LOC> |
This indicates the Location of turret 3 while the sub-spindle is moving, taken from the Transfer Turret Control dialog in FeatureCAM. The values are None, Home, Escape, or Cutoff Location. |
|
<TURRET4-LOC> |
This indicates the Location of turret 4 while the sub-spindle is moving, taken from the Transfer Turret Control dialog in FeatureCAM. The values are None, Home, Escape, or Cutoff Location. |
|
<UDF-COMMENT> |
Used in the UDF Text format to return a comment from an add-in macro that creates a user-defined feature. |
|
<UDF-TEXT> |
Used in the UDF Text format to return a specific code from an add-in macro that creates a user-defined feature. |
|
<UNITS> |
Returns the value from the Inch Units or Metric Units field on the CNC-Info > NC Codes dialog (commonly G20 or G21). |