|
Reserved word |
Definition |
|---|---|
|
BOL |
Beginning of line identifier. Used to indent line in NC code output. Indents line by spacing amount between <BOL> and rest of line. |
|
CANCEL-COOL |
Returns the proper coolant cancellation code from the XBUILD Coolant dialog. |
|
COMP-STAT |
Returns the appropriate code from the CNC-Info > NC Codes dialog for cutter diameter compensation. |
|
COOLANT |
Returns the proper coolant code from the XBUILD Coolant dialog. |
|
COOLANT-OFF-1 through COOLANT-OFF-10 |
Returns the proper coolant cancellation code from the XBUILD Coolant dialog. Use these reserved words instead of the simpler <COOLANT> if your post is using one-pass posting or if you have complex logic for the codes and need more control. |
|
COOLANT-ON-1 through COOLANT-ON-10 |
Returns the proper coolant code from the XBUILD Coolant dialog. Use these reserved words instead of the simpler <COOLANT> if your post is using one-pass posting or if you have complex logic for the codes and need more control. |
|
CYCLE |
Returns the appropriate drill cycle code from the CNC-Info > NC Codes dialog. |
|
CYCLE-RTRCT |
Returns the appropriate retract code for canned drilling cycles from the CNC-Info > NC Codes dialog. |
|
DATE |
Returns the date that the NC code was posted. See also <REGION-DATE>. |
|
EOB |
Specifies the end of block code on each line of a format. |
|
FIXTURE |
Returns the current fixture offset code from the CNC-info > Fixture ID dialog. Note: It is important to include this reserved word in the Segment Start format to ensure that correct Z values are produced.
|
|
F-UNITS |
Returns the applicable code for feed per revolution or feed per linear unit feed rates from the CNC-Info > Feeds & Speeds dialog. For example, G99, G98. |
|
FM-NAME |
Returns the FeatureCAM file name. |
|
HOLDER-NAME |
Returns the tool holder name from the Manufacturing > Spindles and Toolholders dialog in FeatureCAM. |
|
INDEX-AXIS |
Returns the index axis (X, Y, or Z) for 4th-axis indexed parts, otherwise returns None. |
|
MACH-TIME |
Returns the estimated time needed to machine the part. |
|
MATERIAL |
Outputs the name of the material. |
|
MCSID |
Returns the current Setup name, as set in FeatureCAM. |
|
MOTION |
Returns the motion code for the current move from the XBUILD CNC-Info > NC codes dialog. |
|
NEXT-TL-NAME |
For Siemens controls, the name of the next tool. See also <NEXT-TL-ID> (numeric). |
|
OP-PASS |
Returns Rough or Finish based on the type of pass. Value is always in English in order to support language-independent comparison. See also <OP-PASS-LOCAL>. |
|
OP-PASS-LOCAL |
Same as <OP-PASS>, but the value is in the local language, so it can be used for inserting comments in the NC code. |
|
OP-TYPE |
Returns the current operation type name. Value is always in English in order to support language-independent comparison. See also <OP-TYPE-LOCAL>. |
|
OP-TYPE-LOCAL |
Same as <OP-TYPE>, but the value is in the local language, so it can be used for inserting comments in the NC code. |
|
P1 |
Post variable number one. Returns the user-defined string placed in the Post Variables tab in FeatureCAM. Variables up to <P100> may be defined. |
|
PGM-STOP |
Returns string from CNC-Info > NC Codes dialog. Used to stop program to flip part in chuck or vise to machine other setups. |
|
PLANE |
Returns the appropriate code for an active plane from the CNC-Info > NC Codes dialog. |
|
PROG-NAME |
Returns the part name from the Setup definition in FeatureCAM. |
|
PVAR:variablename |
Post variable with the name variablename. Returns the user-defined string placed in the Post Variables tab in FeatureCAM. You can edit the variable names using the Post Variable Names dialog. |
|
REGION-DATE |
Returns the date in the regional format (for example, British DD/MM/YY instead of MM/DD/YY) as specified in Windows. |
|
SEG-CMT |
Returns any Comments entered in a feature's Post Variables dialog in FeatureCAM. For controls that require comments to be a single line, <SEG-CMT> must be only one line. |
|
SEGM-ID |
Returns the name of the current feature from the part view in FeatureCAM. |
|
SPINDLE |
Returns the applicable code for spindle rotation direction from the CNC-Info > NC Codes dialog, for example M3, M4. |
|
TIME |
Returns the time when the NC code was posted. |
|
TOOL-CMT |
Returns any Comments you have entered on the Overrides tab of Tool Properties. |
|
TOOL-ID |
Returns the Tool ID value from the FeatureCAM Tool Mapping dialog. |
|
TOOL-NAME |
Returns the Name of the current tool from the FeatureCAM Tool Mapping dialog. |
|
UDF-COMMENT |
Used in the UDF Text format to return a comment from an add-in macro that creates a user-defined feature. |
|
UDF-TEXT |
Used in the UDF Text format to return a specific code from an add-in macro that creates a user-defined feature. |
|
UNITS |
Returns the value from the Inch Units or Metric Units field on the CNC-Info > NC Codes dialog (commonly G20 or G21). |