Add dimensions in orthographic drawing views

What's New: 2021

1. On the ribbon, click Annotate tab Dimension panel Dimension .
2. In the graphics window, select the geometry and drag to display the dimension.
   • To add a linear dimension for a line or edge, click to select the geometry.
   • To add a linear dimension between two points, two curves, or a curve and a point, click to select each point or curve.
   • To add a linear symmetric or linear diametric dimension, select two parallel lines or edges, right-click, and then select Dimension TypeLinear Symmetric or Linear Diametric.
   • To add a linear foreshortened dimension, select two lines, edges, or points. Then right-click and select Dimension TypeLinear Foreshortened.
   • To add a radial or diametric dimension, click to select an arc or circle.
   • To add an angular dimension, select two lines.
   • To add a foreshortened angular or arc length dimension, select two lines, right-click, and then select Dimension TypeAngular Foreshortened, or Arc Length Foreshortened.
   • To add a dimension that rotates perpendicular to a selected edge: 1) Select a linear edge or 2 points. 2) Right-click and select Dimension Type Rotated. 3) Select a line to establish parallel or perpendicular direction of the dimension.

     

   • To annotate an arc segment with an arc length, angular, or chord length dimension, click to select the arc. Then right-click, and then select Dimension TypeArc Length, Arc Length Foreshortened, Angular, Angular Foreshortened, or Chord Length.
   • To add an implied intersection dimension, select the first curve, right-click, and then select the intersection. Select the second curve that defines the implied intersection, and then select the element (or other implied intersection) to dimension.
   Tip: Selected objects in the drawing determine the type of dimension and commands available in the context menu. To change the settings or use different options, right-click, and click a command on the menu.
3. Click to place the dimension in the appropriate location.
   Tip: When you create a leader line, hold the CTRL key on your keyboard to enable leader line snapping in 15° steps.