In the Document Settings dialog, you can view or change standard, units, text, dimension, line type, width and color settings for the current drawing in the Drawing workspace in Fusion.

Access the Document Settings dialog

In the browser, hover over the Document Settings node, then click the icon Change Document Settings next to it, and the Document Settings dialog displays.

Tabs

The Document Settings dialog options are organized into tabs.

Document Settings Tab

Lets you view or change standard, units, text, line width and revision history settings.

Standard (read-only)

Displays the drafting standard specified when the drawing was created.

• ISO
• ASME

Units (read-only)

Displays the units specified when the drawing was created.

• Millimeters (mm)
• Inches (in)

Projection Angle (read-only)

Displays the projection angle.

• First Angle (ISO)
• Third Angle (ASME)

Delimiter

Lets you choose a comma or full stop to specify the decimal delimiter of a number.

• Decimal
• Comma

Text

Contains all settings related to font and text heights within the current document.

Font

Select a font for text and dimensions from the dropdown menu.

Text Height Group

From the dropdown menu, select a text height for notes, leader notes, hole and thread notes, bend notes, dimensions, symbols, tables, parts lists and balloons.

For units in millimeters:

For units in inches:

Small Text Height

Displays the Small Text Height value. Select Custom to specify a text height other than the default.

Medium Text Height

Displays the Medium Text Height value. Select Custom to specify a text height other than the default.

Large Text Height

Displays the Large Text Height value. Select Custom to specify a text height other than the default.

Units

Units

Select primary dimension units from the dropdown menu.

• Centimeters (cm)
• Millimeters (mm)
• Meters (m)
• Inches (in)
• Feet (ft)

Format (Only for Inches and Feet)

Select a format for dimensions from the dropdown menu.

• Decimal: Can be represented as an inch, meter, millimeter, or any other unit.
• Fractional: The unitless decimal units, which display the value in fractions rather than decimals.
• Engineering: Same as the architectural units, but they represent the feet and inches in the format of the decimal.
• Architectural: The architectural units are based on the feet and inches. It uses fractions to represents the partial inches. It displays feet and inches in the format of decimals and fractions.

Linear Precision

Select a precision for linear dimensions from the dropdown menu.

Linear Precision is based on the Units and Unit Format.

Angular Precision

Select a precision for angular dimensions from the dropdown menu.

• 0
• 0.1
• 0.12
• 0.123
• 0.1234
• 0.12345
• 0.123456
• 0.1234567
• 0.12345678

Zeros/Units

• Leading Zeros

Select to display leading zeros in dimensions.

• Trailing Zeros

Select to display trailing zeros in dimensions.

• Unit Abbreviation

Select to display units in dimensions.

Alternate Units

Units

Select primary dimension units from the dropdown menu.

• Centimeters (cm)
• Millimeters (mm)
• Meters (m)
• Inches (in)
• Feet (ft)

Format (Only for Inches and Feet)

Select a format for dimensions from the dropdown menu.

• Decimal: Can be represented as an inch, meter, millimeter, or any other unit.
• Fractional: The unitless decimal units, which display the value in fractions rather than decimals.
• Engineering: Same as the architectural units, but they represent the feet and inches in the format of the decimal.
• Architectural: Based on the feet and inches. It uses fractions to represents the partial inches. It displays feet and inches in the format of decimals and fractions.

Linear Precision

Select a precision for linear dimensions from the dropdown menu.

Linear Precision is based on the Units and Unit Format.

Zeros/Units

• Leading Zeros

Select to display leading zeros in dimensions.

• Trailing Zeros

Select to display trailing zeros in dimensions.

• Unit Abbreviation

Select to display units in dimensions.

Mass

Select the Mass Units for title block and parts list from the dropdown menu.

• Use Model Settings
• grams (g)
• kilograms (kg)
• ouncemass
• lbmass

Mass Precision

Select the Mass Precision for title block and parts list from the dropdown menu.

• Use Model Settings
• 0
• 0.1
• 0.12
• 0.123
• 0.1234
• 0.12345
• 0.123456
• 0.1234567
• 0.12345678

Line Widths

Contains all settings related to Line Widths.

Line Width Group

Select a Line Width Group from the dropdown menu.

The following list of line widths is available when you select the Custom option.

Thin Line Width

Displays the Thin Line Width value in mm. Select Custom to specify a line width other than the default.

Medium Line Width

Displays the Medium Line Width value in mm. Select Custom to specify a line width other than the default.

Thick Line Width

Displays the Thick Line Width value in mm. Select Custom to specify a line width other than the default.

Display Line Widths

Check the box to display line widths on the sheet in the Fusion canvas.

Line Type Scale

Controls the scale and appearance of dashed lines in the drawing.

Revision History

Contains all settings related to Revision History.

Revision Scope

Select the Revision Scope for your drawing.

• Drawing: Allows you to add the same Revision History table to each sheet of your drawing if needed.
• Sheet: Allows you to modify the Revision History table on each sheet so that each sheet of your drawing has a different Revision History table if needed.

Numbering

Select the Numbering style for your drawing.

• Custom
• A,B,C
• 1,2,3

Standards

Displays the standard revisions used by Surface Texture, Feature Control Frame, Datum Identifiers, Welding, and Taper and Slope symbols. The standard revisions displayed by each symbol follow the document's main Standard settings.

Surface Texture (read-only)

Displays the standard revision used by surface texture symbols.

• ISO 1302:2002(E) (ISO)
• ASME Y14.36M - 1996 (ASME)

Feature Control Frame (read-only)

Displays the standard revision used by feature control frame symbols.

• ISO 1101:2012(E) (ISO)
• ASME Y14.5M - 1994 (ASME)

Datum Identifier (read-only)

Displays the standard revision used by datum identifier symbols.

• ISO 1101:2012(E), ISO 5459:2011(E) (ISO)
• ASME Y14.5M - 1994 (ASME)

Welding (read-only for ISO)

Displays the standard revision used by welding symbols.

• ISO 2553:2019, ISO 4063:2009 (ISO)
• ANSVAWS A2.4 - 2012 (ASME)
• ANSVAWS A2.4 - 1998 (ASME)

Taper and Slope (read-only)

Displays the standard revision used by taper and slope symbols.

• ISO 3040:2009(E) (ISO)
• ASME Y14.5M - 1994 (ASME)

Edge Symbol (read-only)

Displays the standard revision used by edge symbols.

• ISO 13715:2000

Annotation, View, Hatch, Table, and Symbol Tabs

Let you view or change line type, line width, color, gap, and arrowhead settings.

Line Type

Select the Line Type from the dropdown.

• CENTER
• CENTER2
• Continuous
• HIDDEN
• HIDDEN2
• PHANTOM

Line Width

Select the Line Width from the dropdown.

• Thin
• Medium
• Thick

Color

Select the color from the color picker.

Gap Distance (Only in the Annotation Tab)

Lets you type in a specific gap distance value for the dimension lines as they come off of the objects you are dimensioning.

Arrowhead

Select the arrowhead type for dimensions, leaders, balloons, bend IDs, and hole IDs. Mix and match arrowhead types to create the desired look.

The tables below show the object properties you can change, as well as their order within the each Tab.

Annotation Tab

View Tab

The Display Section Line checkbox (only for ISO) gives you the option to display or hide section lines.

Hatch Tab

Table Tab

Symbol Tab

Majority Symbol Types:

• Full List: Placed as a Majority symbol. Displays all edge conditions, including exceptions.
• Simplified List: Placed as a Majority symbol. Groups identical edge conditions.

View Defaults Tab

Lets you view or change all default settings.

Drawing View Defaults

Contains all default settings.

Type

• Assembly
• Animation
• Component
• Sheet Metal: Folded
• Sheet Metal: Flat Pattern

Style

Select the view style for the selected drawing view.

• Visible Edges
• Visible Edges and Hidden Edges
• Shaded
• Shaded with Hidden Edges

Edge Visibility

Adjust the Tangent Edges, Interference Edges, and Thread Edges settings.

Tangent Edges

Select a display style for tangent edges.

• Full Length
• Shortened
• Off

Interference Edges

Check to display edges where components intersect.

Thread Edges

Check to display threads on threaded edges.

Automated Center Marks and Center Lines

Automatically create center lines and center marks for all holes in a view.

Center Marks

Choose the hole types that receive automated center marks.

• Hole: Creates a center mark for hole features.
• Round Extrudes: Creates a center mark for round extrudes.
• Round Cuts: Creates a center mark for round cuts.
• Pattern: Creates a center mark patterns for circular holes.
• Fillet: Creates a center mark for fillets.

Minimum fillet radius (Fillet only)

Specify the minimum fillet radius for a center mark to be created.

Maximum fillet radius (Fillet only)

Specify the maximum fillet radius for a center mark to be created.

Center Lines

Choose the hole types that receive automated center lines.

• Hole: Creates a center line for hole features.
• Round Extrudes: Creates a center line for round extrudes.
• Round Cuts: Creates a center line for round cuts.

Automation Settings Tab

Lets you view or change all settings related to Drawing Automation.

Global Options

Omit Components with Components Name Keywords

Lets you specify which components a sheet is created for.

Per Sheet Options

Lets you control options for a single sheet.

Sheet Type

Lets you control options for the following sheet types:

• Main Assembly: Contains all settings related to the main assembly.
• Sub Assembly: Contains all settings related to the sub assembly.
• Animation: Determines whether drawing sheets for each storyboard in the animation will be generated (when present).
• Component: Determines whether drawing sheets for each component will be generated (when present).
• Sheet Metal: Folded: Determines whether drawing sheets for folded sheet metal components will be generated (when present).
• Sheet Metal: Flat Pattern: Determines whether drawing sheets for flat pattern sheet metal components will be generated (when present).

Generation Options

Sheet w/ Single ISO View

Generates a main assembly sheet with a single ISO view.

Include Parts List

Controls whether a parts list will be added to the main assembly and sub-assembly sheets (including balloons/item numbers).

Default Location

Determines the preferred location for the parts list to be placed.

• Bottom Left
• Bottom Right
• Top Left
• Top Right

Sheet w/ Ortho Views

Generates a main assembly sheet with ortho views.

Include Parts List

Controls whether a parts list will be added to the main assembly and sub-assembly sheets (including balloons/item numbers).

Default Location

Determines the preferred location for the parts list to be placed.

• Bottom Left
• Bottom Right
• Top Left
• Top Right

Add ISO View w/Orthographic Views (Component and Sheet Metal: Folded)

Places an ISO view along with the ortho views.

Include Bend Table (Sheet Metal: Flat Pattern only)

Controls whether a bend table will be added.

Default Location

Determines the preferred location for the parts list to be placed.

• Bottom Left
• Bottom Right
• Top Left
• Top Right

Annotation Options

Auto Dimension

Determines whether the generated sheets will be automatically dimensioned.

Dimension Strategy

Controls the dimensioning strategy that will be used to automatically dimension the sheets in the drawing.

• Automatic
• Baseline
• Chain
• Ordinate
• Overall
• Symmetric
• Symmetric with Baseline
• Symmetric with Ordinate

Default Origin

Controls the location of the origin (when needed).

• Bottom Left
• Bottom Right
• Top Left
• Top Right

Hole Preferences

Determines the preference for how holes are annotated.

• Dimension
• Hole Thread Note

Auto Arrange Dimensions

Controls whether the Auto Arrange feature will be applied to the dimensions after they are placed.

Push to Template

Lets you push the automation settings to an existing template (only the automation settings located on the automation settings tab).