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Manage Participant Bodies API Sample

Description

Demonstrates how to manage participant During Cut operation. Same API can be used to manage participants During intersection also.

Code Samples 

import adsk.core, adsk.fusion, traceback

def run(context):
    ui = None
    try:
        app = adsk.core.Application.get()
        ui = app.userInterface

        # Create a document.
        doc = app.documents.add(adsk.core.DocumentTypes.FusionDesignDocumentType)

        product = app.activeProduct
        design = adsk.fusion.Design.cast(product)

        # Get the root component of the active design.
        rootComp = design.rootComponent

        # Create sketch
        sketches = rootComp.sketches
        sketch = sketches.add(rootComp.xZConstructionPlane)
        sketchCircles = sketch.sketchCurves.sketchCircles
        centerPoint = adsk.core.Point3D.create(0, 0, 0)
        sketchCircles.addByCenterRadius(centerPoint, 3.0)

        # Get the profile defined by the circle.
        prof = sketch.profiles.item(0)

        # Create sketch for Cut
        sketchForCut = sketches.add(rootComp.xZConstructionPlane)
        sketchForCutCircles = sketchForCut.sketchCurves.sketchCircles
        sketchForCutCircles.addByCenterRadius(centerPoint, 1.5)

        # Get the profile defined by the circle.
        profForCut = sketchForCut.profiles.item(0)

        # Create an extrusion input
        extrudes = rootComp.features.extrudeFeatures
        extInput = extrudes.createInput(prof, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)

        # Define that the extent is a distance extent of 5 cm.
        distance = adsk.core.ValueInput.createByReal(5)
        extInput.setDistanceExtent(False, distance)

        # Create the extrusion.
        ext = extrudes.add(extInput)

        # Get the body created by extrusion
        body = ext.bodies.item(0)

        # Create input entities for rectangular pattern
        inputEntites = adsk.core.ObjectCollection.create()
        inputEntites.add(body)

        # Get x and y axes for rectangular pattern
        xAxis = rootComp.xConstructionAxis
        yAxis = rootComp.yConstructionAxis

        # Quantity and distance
        quantityOne = adsk.core.ValueInput.createByString('1')
        distanceOne = adsk.core.ValueInput.createByString('0 cm')
        quantityTwo = adsk.core.ValueInput.createByString('6')
        distanceTwo = adsk.core.ValueInput.createByString('15 cm')

        # Create the input for rectangular pattern
        rectangularPatterns = rootComp.features.rectangularPatternFeatures
        rectangularPatternInput = rectangularPatterns.createInput(inputEntites, xAxis, quantityOne, distanceOne, adsk.fusion.PatternDistanceType.SpacingPatternDistanceType)

        # Set the data for second direction
        rectangularPatternInput.setDirectionTwo(yAxis, quantityTwo, distanceTwo)

        # Create the rectangular pattern
        rectangularFeature = rectangularPatterns.add(rectangularPatternInput)

        patBodies = rectangularFeature.bodies

        body0 = patBodies.item(0)
        face0 = body0.faces.item(0)

        extCutInput = extrudes.createInput(profForCut, adsk.fusion.FeatureOperations.CutFeatureOperation)

         # Set the extrude input
        distanceForCut = adsk.core.ValueInput.createByString('90 cm')
        extCutInput.setDistanceExtent(False, distanceForCut)

        #set bodies to participate
        extCutInput.participantBodies = [patBodies.item(0), patBodies.item(2), patBodies.item(4)]

        extrudes.add(extCutInput)
    except:
        if ui:
            ui.messageBox('Failed:\n{}'.format(traceback.format_exc()))


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