When using the Profile Group Parameters dialog for a Contouring strategy that uses a Turning tool, the following settings are available:
Strategy — Select the type of strategy to be performed.
Tool Location — Select the location of the tool (In, Out, or Face).
Tool Orientation — Select the direction from which the tool cuts (Right or Left).
X-Finish (Fx) — Enter the width of the finishing cut in X.
Z Finish (Fz) — Enter the width of the finishing cut in Z.
Depth of Cut (d) — Enter the amount of material removed on each tool pass.
Initial Stock (q) — Enter the thickness of the initial stock to be contoured.
Diameter Clearance (Cd) — Enter the X distance from the stock that the tool retracts after the initial cutting pass. Also the X distance between the part and the Cutting Point when the cutting point is defined at the stock corner.
Face Clearance (Cf) — Enter the Z distance from the stock that the tool retracts after the initial cutting pass. Also the Z distance between the part and the Cutting Point when the cutting point is defined at the stock corner.
Operations — Select the type of operations to be performed:
- Roughing — Select the Roughing option to include a roughing pass operation.
- Finishing — Select the Finishing option to include a finishing pass operation.
Tool ID — Enter the ID of the tool you want to use for the selected operation or click Select Tools to choose a tool from the Select Tool dialog.
When a tool has been selected, you can click the icon that shows a representation of the tool to display the Edit Tool dialog, where you can view, or modify, details of the tool.
Leads — Click 
to display the Leads dialog, where you can control the movement of the tool as it:
- Approaches the stock before starting a cutting move (Leads In). Leads In consist of an arc that is tangential to the start of the profile and a line tangential to this arc.
- Leaves the stock at the end of a cutting move (Leads Out). Leads Out consist of an arc that is tangential to the end of the profile and a line tangential to this arc.
PartMaker creates Lead In and Lead Out moves when a profile group is created.
Surface Roughness — Enter the surface roughness of the operation, as measured in µin for inch mode and µm in metric mode.
Cutting Point — Click this button to display the Cutting Point dialog, where you can define the Cutting Point for the profile group. The Cutting Point is the point that defines the outside limits of the material to be removed.
Machining Side Defined by — Select whether you want to define the side of the profile being contoured in terms of the Cutting Point or the Tool Location.
Group Name — Enter a name for the profile group.
Select Tools — Click to display the Select Tool dialog, where you can select the tool to use for machining.